Get DimXpert Extrude Feature Example (VBA)
This example shows how to build a part and get attributes
for the following DimXpert feature:
*
Extrude
'----------------------------------------------------------------------------
' Preconditions:
' 1.
Open:
' <SolidWorks_install_dir>\samples\tutorial\api\plate_ads_plusminus.sldprt
' 2.
Open the DimXpert toolbar from View > Toolbars
' (select the first instance
of Toolbars on the View menu).
' 3.
Create the Extrude Feature:
' a.
Click the Auto Dimension Scheme icon on the DimXpert toolbar.
' b.
Ensure that all feature filters are selected.
' c.
Click the green check mark to accept the settings.
' 4.
Observe the following DimXpert features on the DimXpertManager tab:
' Hole
Pattern1, Pocket1.
' 5.
Open an Immediate window in the IDE.
' 6.
Ensure that the latest SolidWorks DimXpert type library is loaded
' in Tools
> References.
' 7.
Run this macro (F5).
'
' Postconditions: Compare
the output in the Immediate Window with
' the features displayed on the DimXpertManager tab of the Management Panel.
' NOTE:
Because this part is used in a SolidWorks online tutorial,
' do not save
any changes when you close it.
'---------------------------------------------------------------------------
Option Explicit
Dim swApp As SldWorks.SldWorks
Dim swModel As SldWorks.ModelDoc2
Dim swModelDocExt As SldWorks.ModelDocExtension
Dim swSelMgr As SldWorks.SelectionMgr
Dim swConfig As SldWorks.ConfigurationManager
Dim swFeature As SldWorks.feature
Dim swAnn As SldWorks.feature
Dim swSchema As SldWorks.DimXpertManager
Dim swDXPart As DimXpertPart
Dim featureType As swDimXpertFeatureType_e
Dim features As Variant
Dim appliedFeatures As Variant
Dim appliedAnnotations As Variant
Dim appliedAnnotation As DimXpertAnnotation
Dim feature As DimXpertFeature
Dim appliedFeature As DimXpertFeature
Dim msgStr As String
Dim msgStr2 As String
Dim msgStr3 As String
Dim msgStr4 As String
Dim n As Long
Dim o As Long
Dim p As Long
Dim boolstatus As Boolean
Sub main()
Set
swApp = Application.SldWorks
Set
swModel = swApp.ActiveDoc
Set
swModelDocExt = swModel.Extension
Set
swSelMgr = swModel.SelectionManager
'
Get the default DimXpert schema using IModelDocExtension.DimXpertManager()
Set
swSchema = swModelDocExt.DimXpertManager("Default", True)
'
Get IDimXpertPart from the IDimXpertManager
Set
swDXPart = swSchema.DimXpertPart
Dim
featCount As Long
featCount
= swDXPart.GetFeatureCount
msgStr
= "Total of "
msgStr2
= featCount
msgStr
= msgStr + msgStr2 + " DimXpert features in " + (swSchema.SchemaName)
Debug.Print
""
Debug.Print
msgStr
'
Get IDimXpert features through IDimXpertPart
features
= swDXPart.GetFeatures
msgStr
= (swSchema.SchemaName) + " has the following features: "
Debug.Print
""
Debug.Print
msgStr
For
n = 0 To UBound(features)
Set
feature = features(n)
Debug.Print
" "
+ "Feature name: " + (feature.Name)
featureType
= feature.Type
Call
GetPatternType(featureType, msgStr2)
msgStr
= " Feature
type "
msgStr3
= " is suppressed on the DimXpertManager tab? "
msgStr4
= feature.IsSuppressed()
Debug.Print
msgStr + msgStr2 + msgStr3 + msgStr4
msgStr
= " "
+ "Model feature: "
Set
swFeature = feature.GetModelFeature()
If
Not (swFeature Is Nothing) Then
msgStr2
= swFeature.GetTypeName2()
Debug.Print
msgStr + msgStr2
End
If
msgStr
= " "
+ "Number of SolidWorks face entities in this feature: "
msgStr2
= feature.GetFaceCount
Debug.Print
msgStr + msgStr2
msgStr
= " "
+ "Number of applied features: "
msgStr2
= feature.GetAppliedFeatureCount()
Debug.Print
msgStr + msgStr2
appliedFeatures
= feature.GetAppliedFeatures()
If
Not (IsEmpty(appliedFeatures)) Then
For
o = 0 To UBound(appliedFeatures)
Set
appliedFeature = appliedFeatures(o)
Debug.Print
" "
+ "Applied feature name: " + (appliedFeature.Name)
Next
End
If
msgStr
= " "
+ "Number of applied annotations: "
msgStr2
= feature.GetAppliedAnnotationCount()
Debug.Print
msgStr + msgStr2
appliedAnnotations
= feature.GetAppliedAnnotations()
If
Not (IsEmpty(appliedAnnotations)) Then
For
p = 0 To UBound(appliedAnnotations)
Set
appliedAnnotation = appliedAnnotations(p)
Debug.Print
" "
+ "Applied annotation name: " + (appliedAnnotation.Name)
Next
End
If
Debug.Print
" "
Next
'
If you know the name of a DimXpert feature, you can get it directly using
IDimXpertPart.GetFeature("name"),
'
which can return a general IDimXpertFeature or a more specific interface
on the feature
'
Get IDimXpertExtrudeFeature for
the Pocket1 feature
Dim
extrudeFeature As IDimXpertExtrudeFeature
Set
extrudeFeature = swDXPart.GetFeature("Pocket1")
msgStr
= extrudeFeature.Name + "
is a DimXpert extrude feature"
Debug.Print
""
Debug.Print
msgStr
Debug.Print
""
'
Get the bottom blends
Set
feature = extrudeFeature.GetBottomBlends
If
Not feature Is Nothing Then
msgStr
= "The bottom blends for the extrude is "
msgStr2
= feature.Name
Debug.Print
msgStr + msgStr2
Else:
Debug.Print "There are no bottom blends for this extrude."
End
If
'
Get the bottom feature
Set
feature = extrudeFeature.GetBottomFeature
If
Not feature Is Nothing Then
msgStr
= "The bottom feature for the extrude is "
msgStr2
= feature.Name
Debug.Print
msgStr + msgStr2
End
If
'
Get the reference feature
Set
feature = extrudeFeature.GetReferenceFeature
If
Not feature Is Nothing Then
msgStr
= "The reference feature for the extrude is "
msgStr2
= feature.Name
Debug.Print
msgStr + msgStr2
End
If
'
Get the sub-features
Dim
featureCount As Integer
featureCount
= extrudeFeature.GetSubFeatureCount
msgStr
= "The number of sub-features of the extrude is "
msgStr2
= featureCount
Debug.Print
msgStr + msgStr2
features
= extrudeFeature.GetSubFeatures
For
n = 0 To UBound(features)
Set
feature = features(n)
Debug.Print
" "
+ "Feature name: " + (feature.Name)
featureType
= feature.Type
Call
GetPatternType(featureType, msgStr2)
msgStr
= " Feature
type is "
Debug.Print
msgStr + msgStr2
Next
'
Get whether the extrude is blind
boolstatus
= extrudeFeature.Blind
msgStr
= "The extrude is blind: "
msgStr2
= boolstatus
Debug.Print
msgStr + msgStr2
End Sub
Public Sub GetPatternType(ByRef featureType, ByRef msgStr2)
If
(featureType = swDimXpertFeature_Plane) Then
msgStr2
= "Plane"
ElseIf
(featureType = swDimXpertFeature_Cylinder) Then
msgStr2
= "Cylinder"
ElseIf
(featureType = swDimXpertFeature_Cone) Then
msgStr2
= "Cone"
ElseIf
(featureType = swDimXpertFeature_Extrude)
Then
msgStr2
= "Extrude"
ElseIf
(featureType = swDimXpertFeature_Fillet) Then
msgStr2
= "Fillet"
ElseIf
(featureType = swDimXpertFeature_Chamfer) Then
msgStr2
= "Chamfer"
ElseIf
(featureType = swDimXpertFeature_CompoundHole) Then
msgStr2
= "CompoundHole"
ElseIf
(featureType = swDimXpertFeature_CompoundWidth) Then
msgStr2
= "CompoundWidth"
ElseIf
(featureType = swDimXpertFeature_CompoundNotch) Then
msgStr2
= "CompoundNotch"
ElseIf
(featureType = swDimXpertFeature_CompoundClosedSlot3D) Then
msgStr2
= "CompoundClosedSlot3D"
ElseIf
(featureType = swDimXpertFeature_IntersectPoint) Then
msgStr2
= "IntersectPoint"
ElseIf
(featureType = swDimXpertFeature_IntersectLine) Then
msgStr2
= "IntersectLine"
ElseIf
(featureType = swDimXpertFeature_IntersectCircle) Then
msgStr2
= "IntersectCircle"
ElseIf
(featureType = swDimXpertFeature_IntersectPlane) Then
msgStr2
= "IntersectPlane"
ElseIf
(featureType = swDimXpertFeature_Pattern) Then
msgStr2
= "Pattern"
ElseIf
(featureType = swDimXpertFeature_Sphere) Then
msgStr2
= "Sphere"
ElseIf
(featureType = swDimXpertFeature_BestfitPlane) Then
msgStr2
= "Bestfit Plane"
ElseIf
(featureType = swDimXpertFeature_Surface) Then
msgStr2
= "Surface"
End
If
End Sub