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Sketch Text PropertyManager

You can sketch text on the face of a part and extrude or cut the text. The text can be inserted on any set of continuous curves or edges, including circles or profiles made up of lines, arcs, or splines.

You can specify the following properties in the Sketch Text PropertyManager.

Curves

Select edges, curves, sketches, or sketch segments. The name of the selected entity appears in the box, and the text appears along the entity.

Text

  • Text. Type text in the Text box. The text appears along the selected entity in the graphics area. If no entity is selected, the text appears horizontally starting at the origin.

  • Link to Property . Lets you link the sketched text to a custom property. You can configure the text using design tables.

  • Style. You can select individual characters, or groups of characters, to apply Bold or Italic or to Rotate .

    Select the text in the Text box, and click Rotate to rotate the selected text 30 degrees counterclockwise. For other rotation angles, select the text, click Rotate and then edit the code in the Text box. For example, for an angle of 10 degrees clockwise, replace <r30> with <r-10>. To return to zero degrees rotation, delete the code and brackets. For angles of 180 degrees, use the Flip Vertical or Flip Horizontal buttons.

  • Alignment. Justify the text Left Align , Center Align , Right Align , or Full Justify . Alignment is available only for text along a curve, edge, or sketch segment.

  • Flip. Flip the text in the Flip Vertical direction and back , or in the Flip Horizontal direction and back . Flip Vertical is available only for text along a curve, edge, or sketch segment.

  • Width Factor . Widen each character evenly by the specified percentage. Width Factor is not available when Use document's font is selected

  • Spacing . Change the spacing between each character by the specified percentage. Spacing is not available when the text is fully justified or when Use document's font is selected.

  • Use document's font. Clear to choose another font.

  • Font. Click to open the Font dialog box and choose a font style and size.



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Web Help Content Version: SOLIDWORKS 2012 SP05

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