Hide Table of Contents

Create Layer for Selected View Example (VBA)

This example shows how to create a layer for the selected drawing view.

 

'------------------------------------------

'

' Preconditions:

'        (1) Drawing of part is open.

'        (2) A view in the drawing is selected.

'

' Postconditions: A layer for the selected view is created.

'

'------------------------------------------

Option Explicit

 

Private Sub ChangeComponentLayer _

( _

    swApp As SldWorks.SldWorks, _

    swDraw As SldWorks.DrawingDoc, _

    sLayerName As String _

)

    Dim bRet                    As Boolean

    

    ' Form a valid layer name

    sLayerName = Replace(sLayerName, "/", "_")

    sLayerName = Replace(sLayerName, "@", "_")

    

    bRet = swDraw.CreateLayer( _

                sLayerName, _

                "Layer for part in " & sLayerName, _

                0, swLineCONTINUOUS, swLW_NORMAL, True): Debug.Assert bRet

    

    ' Changes in all views

    swDraw.ChangeComponentLayer sLayerName, True

End Sub

Sub main()

    Dim swApp                   As SldWorks.SldWorks

    Dim swModel                 As SldWorks.ModelDoc2

    Dim swDraw                  As SldWorks.DrawingDoc

    Dim swSelMgr                As SldWorks.SelectionMgr

    Dim swView                  As SldWorks.view

        

    Dim swDrawModel             As SldWorks.ModelDoc2

    Dim swDrawPart              As SldWorks.PartDoc

    Dim vBody                   As Variant

    Dim swBody                  As SldWorks.body2

    Dim swFace                  As SldWorks.face2

    Dim swEnt                   As SldWorks.entity

    

    Dim nErrors                 As Long

    Dim nWarnings               As Long

    

    Dim bRet                    As Boolean

    

    Set swApp = Application.SldWorks

    Set swModel = swApp.ActiveDoc

    Set swDraw = swModel

    Set swSelMgr = swModel.SelectionManager

    Set swView = swSelMgr.GetSelectedObject5(1)

    Set swDrawModel = swApp.OpenDoc6(swView.GetReferencedModelName, swDocPART, swOpenDocOptions_Silent, "", nErrors, nWarnings)

    Set swDrawPart = swDrawModel

    

    Debug.Print "File           = " & swModel.GetPathName

    Debug.Print "  View         = " & swView.Name

    Debug.Print "    View Model = " & swView.GetReferencedModelName

    

    vBody = swDrawPart.GetBodies2(swSolidBody, True)

    

    Set swBody = vBody(0)

    Set swFace = swBody.GetFirstFace

    Set swEnt = swFace

    

    bRet = swView.SelectEntity(swEnt, False): Debug.Assert bRet

    ChangeComponentLayer swApp, swDraw, swView.Name

End Sub



Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

 
*Email:  
Subject:   Feedback on Help Topics
Page:   Create Layer for Selected View Example (VBA)
*Comment:  
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:




x

We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again
x

Web Help Content Version: API Help (English only) 2012 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.