Function FeatureRevolve2( _
   ByVal SingleDir As Boolean, _
   ByVal IsSolid As Boolean, _
   ByVal IsThin As Boolean, _
   ByVal IsCut As Boolean, _
   ByVal ReverseDir As Boolean, _
   ByVal BothDirectionUpToSameEntity As Boolean, _
   ByVal Dir1Type As Integer, _
   ByVal Dir2Type As Integer, _
   ByVal Dir1Angle As Double, _
   ByVal Dir2Angle As Double, _
   ByVal OffsetReverse1 As Boolean, _
   ByVal OffsetReverse2 As Boolean, _
   ByVal OffsetDistance1 As Double, _
   ByVal OffsetDistance2 As Double, _
   ByVal ThinType As Integer, _
   ByVal ThinThickness1 As Double, _
   ByVal ThinThickness2 As Double, _
   ByVal Merge As Boolean, _
   ByVal UseFeatScope As Boolean, _
   ByVal UseAutoSelect As Boolean _
) As Feature

Dim instance As IFeatureManager
Dim SingleDir As Boolean
Dim IsSolid As Boolean
Dim IsThin As Boolean
Dim IsCut As Boolean
Dim ReverseDir As Boolean
Dim BothDirectionUpToSameEntity As Boolean
Dim Dir1Type As Integer
Dim Dir2Type As Integer
Dim Dir1Angle As Double
Dim Dir2Angle As Double
Dim OffsetReverse1 As Boolean
Dim OffsetReverse2 As Boolean
Dim OffsetDistance1 As Double
Dim OffsetDistance2 As Double
Dim ThinType As Integer
Dim ThinThickness1 As Double
Dim ThinThickness2 As Double
Dim Merge As Boolean
Dim UseFeatScope As Boolean
Dim UseAutoSelect As Boolean
Dim value As Feature
 
value = instance.FeatureRevolve2(SingleDir, IsSolid, IsThin, IsCut, ReverseDir, BothDirectionUpToSameEntity, Dir1Type, Dir2Type, Dir1Angle, Dir2Angle, OffsetReverse1, OffsetReverse2, OffsetDistance1, OffsetDistance2, ThinType, ThinThickness1, ThinThickness2, Merge, UseFeatScope, UseAutoSelect)

Feature FeatureRevolve2( 
   bool SingleDir,
   bool IsSolid,
   bool IsThin,
   bool IsCut,
   bool ReverseDir,
   bool BothDirectionUpToSameEntity,
   int Dir1Type,
   int Dir2Type,
   double Dir1Angle,
   double Dir2Angle,
   bool OffsetReverse1,
   bool OffsetReverse2,
   double OffsetDistance1,
   double OffsetDistance2,
   int ThinType,
   double ThinThickness1,
   double ThinThickness2,
   bool Merge,
   bool UseFeatScope,
   bool UseAutoSelect
)

Feature^ FeatureRevolve2( 
&   bool SingleDir,
&   bool IsSolid,
&   bool IsThin,
&   bool IsCut,
&   bool ReverseDir,
&   bool BothDirectionUpToSameEntity,
&   int Dir1Type,
&   int Dir2Type,
&   double Dir1Angle,
&   double Dir2Angle,
&   bool OffsetReverse1,
&   bool OffsetReverse2,
&   double OffsetDistance1,
&   double OffsetDistance2,
&   int ThinType,
&   double ThinThickness1,
&   double ThinThickness2,
&   bool Merge,
&   bool UseFeatScope,
&   bool UseAutoSelect
) 

Parameters

SingleDir

True if the revolve is in one direction, false if in two directions (see Remarks)

IsSolid

True if this is a solid revolve feature, false if not

IsThin

True if this is a thin revolve feature, false if not

IsCut

True if this is a cut revolve feature, false if not

ReverseDir

True reverses the angle of the revolution, false does not; only applies if Dir1Type is not 6 (mid plane)

BothDirectionUpToSameEntity

True if the revolve is up to the same entity in both directions, false if not; only applies if SingleDir is false and Dir1Type and Dir2Type are 3 (up to vertex), 4 (up to surface), or 5 (offset from surface) (see Remarks)

Dir1Type

Revolve end condition in direction 1:

• 0 - blind
• 3 - up to vertex
• 4 - up to surface
• 5 - offset from surface
• 6 - mid plane

Dir2Type

Revolve end condition in direction 2; only applies if Dir1Type is not 6 (mid plane):

• 0 - blind
• 3 - up to vertex
• 4 - up to surface
• 5 - offset from surface
• 6 - mid plane

Dir1Angle

Angle in radians of revolution in direction 1; only applies if Dir1Type is 0 (blind)

Dir2Angle

Angle in radians of revolution in direction 2; only applies if Dir2Type is 0 (blind)

OffsetReverse1

True to reverse the offset direction in direction 1, false to not; only applies if Dir1Type is 5 (offset from surface)

OffsetReverse2

True to reverse the offset direction in direction 2, false to not; only applies if Dir2Type is 5 (offset from surface)

OffsetDistance1

Offset distance in direction 1; only applies if Dir1Type is 5 (offset from surface)

OffsetDistance2

Offset distance in direction 2; only applies if Dir2Type is 5 (offset from surface)

ThinType

Type and direction as defined in swThinWallType_e

ThinThickness1

Wall thickness in direction 1 (if ThinType is swThinWallType_e.swThinWallMidPlane, (ThinThickness1)/2 is used for each direction)

ThinThickness2

Wall thickness in direction 2 (only applies if ThinType is swThinWallType_e.swThinWallTwoDirection)

Merge

True to merge the results into a multi-body part, false to not

UseFeatScope

True if the feature only affects selected bodies, false if the feature affects all bodies

UseAutoSelect

True to automatically select all bodies and have the feature affect those bodies, false to select the bodies or components that the feature affects (see Remarks)

Return Value

Before calling this method, call IModelDocExtension::SelectByID2 multiple times to select the sketch, axis of revolution, up-to face, up-to plane, or offset-from surface. To select the axis of revolution, set Mark to 16. To select each successive face, plane, or surface, set Mark to its next bitmask value.

If SingleDir is false and the revolve is up to or offset from the same entity in both directions, select the entity once and set BothDirectionUpToSameEntity to true. If you select the same entity for each direction, the second selection negates the first, and the revolve feature is not created.

When UseAutoSel is false, you must call IModelDocExtension::SelectByID2 to select the bodies or components affected by the feature.