Function InsertSheetMetalHem2( _
   ByVal Type As Integer, _
   ByVal Position As Integer, _
   ByVal Reverse As Boolean, _
   ByVal DLength As Double, _
   ByVal DGap As Double, _
   ByVal DAngle As Double, _
   ByVal DRad As Double, _
   ByVal DMiterGap As Double, _
   ByVal PCBA As CustomBendAllowance, _
   ByVal UseDefaultRelief As Boolean, _
   ByVal ReliefType As Integer, _
   ByVal ReliefTearTypes As Integer, _
   ByVal UseReliefRatio As Boolean, _
   ByVal ReliefRatio As Double, _
   ByVal ReliefWidth As Double, _
   ByVal ReliefDepth As Double _
) As Feature

Dim instance As IFeatureManager
Dim Type As Integer
Dim Position As Integer
Dim Reverse As Boolean
Dim DLength As Double
Dim DGap As Double
Dim DAngle As Double
Dim DRad As Double
Dim DMiterGap As Double
Dim PCBA As CustomBendAllowance
Dim UseDefaultRelief As Boolean
Dim ReliefType As Integer
Dim ReliefTearTypes As Integer
Dim UseReliefRatio As Boolean
Dim ReliefRatio As Double
Dim ReliefWidth As Double
Dim ReliefDepth As Double
Dim value As Feature
 
value = instance.InsertSheetMetalHem2(Type, Position, Reverse, DLength, DGap, DAngle, DRad, DMiterGap, PCBA, UseDefaultRelief, ReliefType, ReliefTearTypes, UseReliefRatio, ReliefRatio, ReliefWidth, ReliefDepth)

Feature InsertSheetMetalHem2( 
   int Type,
   int Position,
   bool Reverse,
   double DLength,
   double DGap,
   double DAngle,
   double DRad,
   double DMiterGap,
   CustomBendAllowance PCBA,
   bool UseDefaultRelief,
   int ReliefType,
   int ReliefTearTypes,
   bool UseReliefRatio,
   double ReliefRatio,
   double ReliefWidth,
   double ReliefDepth
)

Feature^ InsertSheetMetalHem2( 
&   int Type,
&   int Position,
&   bool Reverse,
&   double DLength,
&   double DGap,
&   double DAngle,
&   double DRad,
&   double DMiterGap,
&   CustomBendAllowance^ PCBA,
&   bool UseDefaultRelief,
&   int ReliefType,
&   int ReliefTearTypes,
&   bool UseReliefRatio,
&   double ReliefRatio,
&   double ReliefWidth,
&   double ReliefDepth
) 

Parameters

Type

Type as defined in swHemTypes_e

Position

Position as defined in swHemPositionTypes_e

Reverse

True reverses the direction, false does not

DLength

Hem length; valid only for open or closed hems

DGap

Gap distance; valid only for open hems

DAngle

Hem angle; valid only for tear-drop or rolled hems

DRad

Hem radius; valid only for tear-drop or rolled hems

DMiterGap

Hem miter gap

PCBA

If...	Then...
non-NULL	Pointer to ICustomBendAllowance object for which required values have been set
NULL	Parent bend's bend allowance is used

UseDefaultRelief

True to use the default relief, false to use the relief specified by ReliefType

ReliefType

Type of relief as defined in swSheetMetalReliefTypes_e; valid only if UseDefaultRelief is false

ReliefTearTypes

Type of relief tear as defined in  swReliefTearTypes_e; valid only when:

• UseDefaultRelief is false

    - and -

• ReliefType is swSheetMetalReliefTypes_e.swSheetMetalReliefTear

UseReliefRatio

True to use ReliefRatio, false to use ReliefWidth/ReliefDepth; valid only when:

• UseDefaultRelief is false

    - and -

• ReliefType is either swSheetMetalReliefTypes_e.swSheetMetalReliefObround or swSheetMetalReliefTypes_e.swSheetMetalReliefRectangular

ReliefRatio

Relief ratio; valid only when:

• UseDefaultRelief is false

    - and -

• UseReliefRatio is true

    - and -

• ReliefType is either swSheetMetalReliefTypes_e.swSheetMetalReliefObround or swSheetMetalReliefTypes_e.swSheetMetalReliefRectangular

ReliefWidth

Width of the relief; valid only when:

• UseDefaultRelief is false

    - and -

• UseReliefRatio is false

    - and -

• ReliefType is either swSheetMetalReliefTypes_e.swSheetMetalReliefObround or swSheetMetalReliefTypes_e.swSheetMetalReliefRectangular

ReliefDepth

Depth of the relief; valid only when:

• UseDefaultRelief is false

    - and -

• UseReliefRatio is false

    - and -

• ReliefType is either swSheetMetalReliefTypes_e.swSheetMetalReliefObround or swSheetMetalReliefTypes_e.swSheetMetalReliefRectangular

Return Value

Before calling this method:

1. Call IFeatureManager::CreateCustomBendAllowance to create an instance of ICustomBendAllowance.
2. Initialize the CustomBendAllowance object.
3. Assign PCBA to the initialized CustomBendAllowance object.
4. Select one or more edges in the sheet metal model to which to add the specified hem.