Bill of Materials PropertyManager

Specify properties for Bills of Materials.

To specify properties for Bills of Materials:

1. Access the PropertyManager by one of the following methods:

• Click Bill of Materials on the Table toolbar, or with a document open, click Insert, Tables, Bill of Materials.

• Click the pan icon in the upper left corner of an existing bill of materials.

2. Specify the properties described below, then click OK .

BOM Options

Select:

• Create new table to create a new drawing table.

• Copy existing table to copy a BOM saved from a referenced assembly or part. Select a BOM from the list. Select Linked to link the data in the drawing BOM to the assembly BOM. You can unlink the BOMs but you cannot re-link them. Changes made in either BOM are reflected in the other. Formatting is not linked.

Table Template

Click Open table template for Bill of Materials to choose a standard or custom template. This option is available only during table insertion.

The BOM columns match those of the template you select.

Table Position

The stationary corner controls the direction in which the table expands when adding new columns or rows.

Set the Stationary corner to:

Top Left. New columns extend to the right and new rows extend below the anchor point.

Top Right. New columns extend to the left and new rows extend below the anchor point.

Bottom Left. New columns extend to the right and new rows extend above the anchor point.

Bottom Right. New columns extend to the left and new rows extend above the anchor point.

Attach to anchor point. Attaches the specified corner to the table anchor.

The Stationary corner option is not available when you first create the table. If the table is anchored on creation, the stationary corner is automatically selected on the drawing sheet in the quadrant nearest the table anchor.

BOM Type

Select:

• Top-level only. List parts and sub-assemblies, but not sub-assembly components.

• Parts only. Does not list sub-assemblies. Lists sub-assembly components as individual items.

• Indented. Lists sub-assemblies. Indents sub-assembly components below their sub-assemblies. Select:

• • No numbering

  • Detailed numbering

  • Flat numbering

When creating a BOM for a document that includes weldment parts, select Detailed cut list to display detailed cut information.

If you change the BOM Type of an existing BOM, the document file size increases and may slow performance. It is recommended that you delete the original BOM, then insert a new BOM with the desired BOM Type.

You can dissolve subassemblies in a bill of materials.

BOM Scaling

Lets you scale the BOM size. Available only after you click the pan icon in the upper left corner of an existing bill of materials in a part or assembly.

Configurations

Lists quantities in the Bill of Materials for all selected configurations. Select configurations manually, or click Select all configurations or Unselect all configurations .

Part Configuration Grouping

Specifies how parts with multiple assembly configurations are listed in the BOM.

Display as one item number. Uses the same item number for different configurations of a component in different top-level assembly configurations. Each unique component configuration can be present in only one of the assembly configurations in the BOM. This option applies when you first create a BOM. If you toggle it after the BOM is created, there is no change. When you use this option, set BOM Type to Top-level only.

For example, one configuration of an assembly has the following components:

• part1 (config_A)

• part1 (config_A)

• part1 (config_A)

and another configuration of the same assembly has different configurations of the same component:

• part1 (config_B)

• part1 (config_B)

• part1 (config_B)

A Top-level only BOM that references both assembly configurations with Display as one item number selected appears as:

To see the configuration name in the PART NUMBER column, go to the part document. On the ConfigurationManager tab, right-click each configuration, and select Properties. Under Part number displayed when used in a bill of materials, select Configuration Name. Alternatively, right-click a component in the BOM's assembly structure column and click Component Options. Under Part Number, select Configuration Name, then click .

Display configurations of the same part as separate items. If a component has multiple configurations, each configuration is listed in the BOM.

Display all configurations of the same part as one item. If a component has multiple configurations, the component is listed in only one row in the BOM.

Display configurations with the same name as one item. If more than one component has the same configuration name, they are listed in one row of the BOM. For this option to work properly, Part number displayed when used in a bill of materials in the part must be set to either:

• The same User Specified Name

• Configuration Name (if different components in the assembly have the same configuration names)

For example, an assembly has the following components:

• part1 (config_A)

• part1 (config_A)

• part2 (config_A)

When you select Display configurations with the same name as one item, the BOM appears as:

Item Numbers

Border

Box Border and Grid Border . Select a corresponding border thickness from the list.

Table with thicker box and grid borders:

Layer

In drawings with named layers, select a layer. The table assumes the layer color.