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Replace Components PropertyManager

An assembly and its components may go through many revisions during the course of a design cycle. This is especially true in a multi-user environment where several users can work on the individual parts and sub-assemblies. A safe, efficient way to update the assembly is to replace the components as needed.

  • You can replace a part with a sub-assembly or vice versa.

  • You can replace one, more than one, or all instances of a component at the same time.

To replace one or more components:

  1. Do one of the following:

    • Click Replace Components (Assembly toolbar).

    • Click File, Replace.

    • Right-click a component and select Replace Components.

  1. Set options as described below, then click .

The selected component instances are replaced.

If you chose Manually select, choose the configuration to open in the Configurations dialog box.

If you selected Re-attach mates, the Mated Entities PropertyManager appears.  Additionally, a window shows a view of the original component with the missing mate entity highlighted, and the Missing Entities popup toolbar appears.

Selections

Replace these component(s) . Select the components to replace. Select All instances to replace all instances of the selected component.

With this one . Displays a list of open files. Select from the list or click Browse to locate the replacement component.

Options

Configuration. Select one of the following:

  • Match name. The software tries to match the configuration name of the old component with a configuration in the replacement component.

  • Manually select. Enables you to select the matching configuration in the replacement component.

Re-attach mates. The software tries to re-attach existing mates to the replacement component.

If the old component has a mate that includes a named entity, and the replacement component has a corresponding entity with the same name, the software uses the corresponding entity when re-attaching the mate. You assign names to entities in the Entity Property dialog box. To access face and edge names in a lightweight component, either resolve the component or save the assembly in SolidWorks 2012 or later.

Related Topics

Referenced Files

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