Jog
The Jog tool adds material to a sheet metal part by creating two bends from a sketched line.
Some additional items to note about the Jog tool:
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The sketch must contain only one line.
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The line does not need to be horizontal or vertical.
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The bend line does not have to be the exact length of the faces you are bending.
To create a jog feature on a sheet metal part:
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Sketch a line on the face of a sheet metal part where you want to create the jog. Alternatively, you can select the Jog feature before you create a sketch (but after you select a plane). When you select the Jog feature, a sketch opens on the plane.
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Click Jog  on the Sheet Metal toolbar, or click Insert, Sheet Metal, Jog.
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In the graphics area, select a face for Fixed Face  .
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Under Selections, to edit the bend radius, clear Use default radius and Use gauge table (if a sheet metal gauge table has been selected for the part), and type a new value for Bend Radius  .
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Under Jog Offset:
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Select an item in End Condition.
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Set a value for Offset Distance  .
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Select Reverse offset to reverse the offset direction. Reverse offset is available when End Condition is set to Offset From Surface.
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Select a Dimension position: Outside Offset 
, Inside Offset  , or Overall Dimension  .
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Select
if you want the face of the jog to stay the same length.
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Under Jog Position, select: Bend Centerline 
, Material Inside  , Material Outside  , or Bend Outside 
.
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Set a value for Jog Angle  . If a sheet metal gauge table has been selected for the part, you can select Override value to override the Jog Angle presets with a value that you set.
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To use something other than the default bend allowance, select Custom Bend Allowance, and set a bend allowance type and value.
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Click OK  .
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