Trim Entities

Use Power trim to:

• Trim multiple, adjacent sketch entities by dragging the pointer across each sketch entity.

• Extend sketch entities along their natural paths.

Arcs have a maximum extension length on either side of the arc. Once you reach the maximum extension length, the extension shifts to the opposite side.

To trim with the Power trim option:

1. Right-click the sketch and select Edit Sketch.

2. Click Trim Entities Sketch toolbar) or Tools, Sketch Tools, Trim.

3. In the PropertyManager, under Options, select Power trim .

4. Click in the graphics area next to the first entity, and drag across the sketch entity to trim.

• The pointer changes to as it crosses and trims the sketch entity.

• A trail is created along the trim path.

6. Continue to hold down the pointer and drag across each sketch entity you want to trim.

7. Release the pointer when finished trimming the sketch, then click OK .

Extends or trims two sketch entities until they intersect at a virtual corner.

To trim with the Corner option:

1. Right-click the sketch and select Edit Sketch.

2. Click Trim Entities on the Sketch toolbar, or click Tools, Sketch Tools, Trim.

3. In the PropertyManager, under Options, select Corner .

4. Select the two sketch entities you want to joined.

Depending on the sketch entities and their relative position to each other, the software extends or trims each entity to join them. A message appears when the operation cannot be completed.

5. Click OK .

Trims open sketch entities that lie inside two bounding entities.

To trim with the Trim away inside option:

1. Right-click the sketch and select Edit Sketch.

2. Click Trim Entities on the Sketch toolbar, or click Tools, Sketch Tools, Trim.

3. In the PropertyManager, under Options, select Trim away inside .

4. Select two bounding sketch entities.

5. Select the sketch entities to trim.

  The sketch entities you select to trim must either intersect each bounding entity once, or not intersect the two bounding entities at all.

6. Click OK .

Trims open sketch entities outside of two bounding entities.

The same rules that govern the Trim away inside option govern the Trim away outside option.

1. Right-click the sketch and select Edit Sketch.

2. Click Trim Entities on the Sketch toolbar, or click Tools, Sketch Tools, Trim.

3. In the PropertyManager, under Options, select Trim away outside .

4. Select two bounding sketch entities.

5. Select the sketch entities to trim.

6. Click OK .

1. Right-click the sketch and select Edit Sketch.

2. Click Trim Entities on the Sketch toolbar, or click Tools, Sketch Tools, Trim.

3. In the PropertyManager, under Options, click Trim to closest .

The pointer changes to .

4. Select each sketch entity you want trimmed or extended to the closest intersection:

• To extend, select the entity and drag to the intersection.

• To trim, select the sketch entity.

5. Click OK .