Hide Table of Contents

Linear Component Pattern

You can create a linear pattern of components in an assembly in one or two directions.

To create a linear pattern of components:

  1. Click Linear Component Pattern Tool_LinearComponentPattern_Assembly.gif (Assembly toolbar) or Insert > Component Pattern > Linear Pattern.
  2. In the PropertyManager, under Direction 1:
    1. Select a linear edge or a linear dimension for Pattern Direction.
    2. Click Reverse Direction if necessary.
    3. Type a value for Spacing . This is the value between the centers of the instances.
    4. Type a value for Number of Instances . This is the total number of instances including the seed components.
  3. Repeat for Direction 2 for a bidirectional pattern.

    Select Pattern seed only to pattern the seed component only in the second direction. When cleared, SolidWorks patterns all of the instances generated by Direction 1 and the seed component in the second direction.

  4. Click in Components to Pattern , then select the seed components.
  5. To skip instances, click in Instances to Skip and select the preview of the instance in the graphics area.

    The pointer changes to when it is over a preview in the graphics area.

  6. To restore instances, select the instance in Instances to Skip and press Delete.
  7. Click .

    The new components appear under LocalLPattern in the FeatureManager design tree.

    By default, all instances use the same configuration as the seed components. To change the configuration, edit the component properties of an instance.

Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

Subject:   Feedback on Help Topics
Page:   Linear Component Pattern
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:


We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again

Web Help Content Version: SOLIDWORKS 2013 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.