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Replace Components PropertyManager

An assembly and its components may go through many revisions during the course of a design cycle. This is especially true in a multi-user environment where several users can work on the individual parts and subassemblies. A safe, efficient way to update the assembly is to replace the components as needed.

  • You can replace a part with a subassembly or vice versa.
  • You can replace one, more than one, or all instances of a component at the same time.
  • You can replace a component with another that has the same name and type but comes from a different folder.

To replace one or more components:

  1. Do one of the following:
    • Click Replace Components (Assembly toolbar).
    • Click File > Replace
    • Right-click a component and select Replace Components.
  2. Set options as described below, then click .

    The selected component instances are replaced.

    If you chose Manually select, choose the configuration to open in the Configurations dialog box.

    If you selected Re-attach mates, the Mated Entities PropertyManager appears. Additionally, a window shows a view of the original component with the missing mate entity highlighted, and the Missing Entities popup toolbar appears.


Replace these component(s) Select the components to replace. Select All instances to replace all instances of the selected component.
With this one Displays a list of open files. Select from the list or click Browse to locate the replacement component.


Configuration Select one of the following:

Match name

The software tries to match the configuration name of the old component with a configuration in the replacement component.

Manually select

Enables you to select the matching configuration in the replacement component.

Re-attach mates The software tries to re-attach existing mates to the replacement component.
If the old component has a mate that includes a named entity, and the replacement component has a corresponding entity with the same name, the software uses the corresponding entity when re-attaching the mate. You assign names to entities in the Entity Property dialog box. To access face and edge names in a lightweight component, either resolve the component or save the assembly in SolidWorks 2012 or later.

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