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Insert Sheet Metal Gusset Feature Example (VBA)

This example shows how to insert a sheet metal gusset feature and modify its data.

'----------------------------------------------------------------------------
' Preconditions: Open:
'    install_dir\samples\tutorial\api\SMGussetAPI.sldprt
'
' Postconditions:
' 1. Five gussets are inserted in the sheet metal.
' 2. Press F5 repeatedly and observe the gusset modifications.
'
' NOTE: Because the model is used elsewhere, do not save changes.
' ---------------------------------------------------------------------------

Dim swApp As SldWorks.SldWorks
Dim Part As SldWorks.ModelDoc2
Dim myFeature As SldWorks.Feature
Dim myFeature1 As SldWorks.Feature
Dim myFeature2 As SldWorks.Feature
Dim myFeature3 As SldWorks.Feature
Dim myFeature4 As SldWorks.Feature
Dim swFeat As SldWorks.Feature
Dim swFeatData As SldWorks.SMGussetFeatureData
Dim boolstatus As Boolean
Option Explicit

Sub main()

    Set swApp = Application.SldWorks
    Set Part = swApp.ActiveDoc
   
    boolstatus = Part.Extension.SelectByID2("", "FACE", -5.38403893476698E-02, 3.6701308754914E-03, 0.05530817474488, False, 0, Nothing, 0)
    boolstatus = Part.Extension.SelectByID2("", "FACE", -1.77780871801474E-02, -3.07393226379986E-02, 3.41128529187245E-02, True, 0, Nothing, 0)
   

    ' Gusset #1 insertion parameters
    '1.  bOffset                    = True
    '2.  dOffset                    = 50 mm
    '3.  bFlipOffsetSide            = False
    '4.  profDimType                = 0 (indent depth dimensioning scheme)
    '5.  dIndentDepth,              = 10 mm
    '6.  dLength                    = 0
    '7.  bUseAngle,                 = False
    '8.  dHeight                    = 0
    '9   dAngle                     = 0
    '10. bFlipSides                 = False
    '11. dWidth                     = 10 mm
    '12. dThickness                 = 3 mm
    '13. bDraft                     = True
    '14. dDraftAngle                = 3 degrees
    '15. bInnerCornerFillet,        = True
    '16. dInnerCornerFilletRadius   = 2 mm
    '17. bOuterCornerFillet         = True
    '18. dOuterCornerFilletRadius   = 1 mm
    '19. gussetType                 = 0 (rounded back)
    '20  bEdgeFillet                = False
    '21. dEdgeFilletRadius          = 0 mm
   

    Set myFeature = Part.FeatureManager.InsertSheetMetalGussetFeature(True, 0.05, False, swSheetMetalGussetProfileDimType_IndentDepth, 0.01, 0, False, 0, 0, True, 0.01, 0.003, True, 3 * 0.0175, True, 0.002, True, 0.001, swSheetMetalRibGussetType_Rounded, False, 0)
    Part.ClearSelection2 True
   

    ' Gusset #2 insertion parameters
    '2.  dOffset                = 30 mm
    '19. gussetType             = 1 (flat back)
    '20  bEdgeFillet            = True
    '21. dEdgeFilletRadius      = 1 mm
   

    'Select faces
    boolstatus = Part.Extension.SelectByID2("", "FACE", -5.38403893476698E-02, 3.6701308754914E-03, 0.05530817474488, False, 0, Nothing, 0)
    boolstatus = Part.Extension.SelectByID2("", "FACE", -1.77780871801474E-02, -3.07393226379986E-02, 3.41128529187245E-02, True, 0, Nothing, 0)
   

    Set myFeature1 = Part.FeatureManager.InsertSheetMetalGussetFeature(True, 0.03, False, swSheetMetalGussetProfileDimType_IndentDepth, 0.01, 0, False, 0, 0, False, 0.01, 0.003, True, 3 * 0.0175, True, 0.002, True, 0.001, swSheetMetalRibGussetType_Flat, True, 0.001)
    Part.ClearSelection2 True
   

    ' Gusset #3 insertion parameters
    '2.  dOffset                = 30 mm
    '4.  profDimType            = 1 (length + height dimensioning scheme)
    '5.  dIndentDepth,          = 0 mm
    '6.  dLength                = 25 mm
    '7.  bUseAngle,             = False
    '8.  dHeight                = 15 mm
    '9   dAngle                 = 0
    '10. bFlipSides             = False
    '19. gussetType             = 1 (flat back)
    '20  bEdgeFillet            = True
    '21. dEdgeFilletRadius      = 1 mm

    boolstatus = Part.Extension.SelectByID2("", "FACE", -5.38403893476698E-02, 3.6701308754914E-03, 0.05530817474488, False, 0, Nothing, 0)
    boolstatus = Part.Extension.SelectByID2("", "FACE", -1.77780871801474E-02, -3.07393226379986E-02, 3.41128529187245E-02, True, 0, Nothing, 0)
   

    Set myFeature2 = Part.FeatureManager.InsertSheetMetalGussetFeature(True, 0.03, False, swSheetMetalGussetProfileDimType_ProfileDimensions, 0, 0.025, False, 0.015, 0, False, 0.02, 0.003, True, 3 * 0.0175, True, 0.002, True, 0.001, swSheetMetalRibGussetType_Flat, True, 0.001)
    Part.ClearSelection2 True
   

    ' Gusset #4
    'Select orientation and position references
    boolstatus = Part.Extension.SelectByID2("", "FACE", -5.38403893476129E-02, -2.24553153327633E-03, 0.087801420904043, True, 0, Nothing, 0)
    boolstatus = Part.Extension.SelectByID2("", "FACE", -2.35965800548001E-02, -3.07393226379986E-02, 8.97844682415894E-02, True, 0, Nothing, 0)
    boolstatus = Part.Extension.SelectByID2("Line1@Sketch6", "EXTSKETCHSEGMENT", -6.09049483400968E-03, -8.95139047397037E-02, 0, True, 0, Nothing, 0)
    boolstatus = Part.Extension.SelectByID2("Point1@Sketch7", "EXTSKETCHPOINT", 1.80407947995604E-02, -7.62728416981986E-02, 0, True, 0, Nothing, 0)
   

    Set myFeature3 = Part.FeatureManager.InsertSheetMetalGussetFeature(True, 0.03, False, swSheetMetalGussetProfileDimType_IndentDepth, 0.01, 0, False, 0, 0, False, 0.01, 0.003, True, 3 * 0.0175, True, 0.002, True, 0.001, swSheetMetalRibGussetType_Rounded, True, 0.001)
    Part.ClearSelection2 True
   

    ' Gusset #5
    'Pass support, orientation, and position references in the insertion method

    Dim arrayOfFaces(0 To 1) As Object
    boolstatus = Part.Extension.SelectByID2("", "FACE", -5.38403893476129E-02, 2.15261807674665E-02, 0.127524627462805, True, 0, Nothing, 0)
    Set arrayOfFaces(0) = Part.SelectionManager.GetSelectedObject6(1, -1)
    boolstatus = Part.Extension.SelectByID2("", "FACE", 1.29199133115776E-02, -3.07393226378281E-02, 6.73442494212964E-02, True, 0, Nothing, 0)
    Set arrayOfFaces(1) = Part.SelectionManager.GetSelectedObject6(1, -1)
   

    Dim arrayOfRefLines(0) As Object
    boolstatus = Part.Extension.SelectByID2("", "EDGE", -5.38278103537095E-02, -1.23578076746185E-02, 0.214291961345026, True, 0, Nothing, 0)
    Set arrayOfRefLines(0) = Part.SelectionManager.GetSelectedObject6(1, -1)
   

    Dim arrayRefPoints(0) As Object
    boolstatus = Part.Extension.SelectByID2("", "VERTEX", -5.38403893475499E-02, 1.16094138400761E-02, 0.200245910723487, True, 0, Nothing, 0)
    Set arrayRefPoints(0) = Part.SelectionManager.GetSelectedObject6(1, -1)
   

    Set myFeature4 = Part.FeatureManager.InsertSheetMetalGussetFeature2(True, 0.15, False, swSheetMetalGussetProfileDimType_ProfileDimensions, 0, 0.025, True, 0, 60 * 0.0175, True, 0.02, 0.003, True, 3 * 0.0175, True, 0.002, True, 0.001, swSheetMetalRibGussetType_Flat, True, 0.001, arrayOfFaces, arrayOfRefLines, arrayRefPoints)
    Part.ClearSelection2 True
   

    Stop
   

    'Six examples of modifying gusset feature data:
       

        'a. Modify type, draft, and outer corner fillet options for gusset #4
        boolstatus = Part.Extension.SelectByID2("Sheet Metal Gusset4", "BODYFEATURE", 0, 0, 0, False, 0, Nothing, 0)
        Set swFeat = Part.SelectionManager.GetSelectedObject6(1, -1)
       

        Set swFeatData = swFeat.GetDefinition
        swFeatData.AccessSelections Part, Nothing
       

        swFeatData.GussetType = 1 'flat back
        swFeatData.DraftSideFaces = False
        swFeatData.FilletOuterCorners = False 'no outer corner fillet
       

        swFeat.ModifyDefinition swFeatData, Part, Nothing
        swFeatData.ReleaseSelectionAccess
       

        Stop
       

        'b. Modify type and inner corner fillet options for gusset #5
        boolstatus = Part.Extension.SelectByID2("Sheet Metal Gusset5", "BODYFEATURE", 0, 0, 0, False, 0, Nothing, 0)
        Set swFeat = Part.SelectionManager.GetSelectedObject6(1, -1)
       

        Set swFeatData = swFeat.GetDefinition
        swFeatData.AccessSelections Part, Nothing
       

        swFeatData.GussetType = 0 'rounded back
        swFeatData.FilletInnerCorners = False 'no inner corner fillet
       

        swFeat.ModifyDefinition swFeatData, Part, Nothing
        swFeatData.ReleaseSelectionAccess
       

        Stop
       

        'c. Modify legs of gusset #5: select one bend face instead of two flat faces
        boolstatus = Part.Extension.SelectByID2("Sheet Metal Gusset5", "BODYFEATURE", 0, 0, 0, False, 0, Nothing, 0)
        Set swFeat = Part.SelectionManager.GetSelectedObject6(1, -1)
       

        Set swFeatData = swFeat.GetDefinition
        swFeatData.AccessSelections Part, Nothing
       

        boolstatus = Part.Extension.SelectByID2("", "FACE", -5.32822252084202E-02, -2.87774016125013E-02, 3.00897654936705E-02, False, 0, Nothing, 0)
        Dim faces(0 To 1) As Object
        Dim ii As Integer
        For ii = 0 To 1
           Set faces(ii) = Part.SelectionManager.GetSelectedObject6(ii + 1, -1)
        Next ii
        Dim facesVar As Variant
        facesVar = faces
        swFeatData.SupportingFaces = facesVar
       

        swFeat.ModifyDefinition swFeatData, Part, Nothing
       

        Stop
       

        'd. Modify orientation reference of gusset #3
         boolstatus = Part.Extension.SelectByID2("Sheet Metal Gusset3", "BODYFEATURE", 0, 0, 0, False, 0, Nothing, 0)
        Set swFeat = Part.SelectionManager.GetSelectedObject6(1, -1)
       

        Set swFeatData = swFeat.GetDefinition
        swFeatData.AccessSelections Part, Nothing
       

        boolstatus = Part.Extension.SelectByID2("Line1@Sketch6", "EXTSKETCHSEGMENT", -6.09049483400968E-03, -8.95139047397037E-02, 0, True, 0, Nothing, 0)
   

        Dim refLine As Variant
        Set refLine = Part.SelectionManager.GetSelectedObject6(1, -1)
        swFeatData.referenceline = refLine
       

        swFeat.ModifyDefinition swFeatData, Part, Nothing
       

        Stop
           

        'e. Modify legs of gusset #2: gusset moved to bend of edge flange
         boolstatus = Part.Extension.SelectByID2("Sheet Metal Gusset2", "BODYFEATURE", 0, 0, 0, False, 0, Nothing, 0)
        Set swFeat = Part.SelectionManager.GetSelectedObject6(1, -1)
       

        Set swFeatData = swFeat.GetDefinition
        swFeatData.AccessSelections Part, Nothing
       

        boolstatus = Part.Extension.SelectByID2("", "FACE", 0.03831148650454, -3.27672470662037E-02, 0.147978181958194, False, 0, Nothing, 0)
   

        Dim newBendFace As Variant
        Dim bendfaces(0 To 1) As Object
        Dim jj As Integer
        For jj = 0 To 1
           Set bendfaces(jj) = Part.SelectionManager.GetSelectedObject6(jj + 1, -1)
        Next jj
        newBendFace = bendfaces
        swFeatData.SupportingFaces = newBendFace
       

        swFeat.ModifyDefinition swFeatData, Part, Nothing
       

        Stop
       

        'f. Modify reference position of gusset #3 - 3 mm away from vertex of hexagonal cut
         boolstatus = Part.Extension.SelectByID2("Sheet Metal Gusset3", "BODYFEATURE", 0, 0, 0, False, 0, Nothing, 0)
        Set swFeat = Part.SelectionManager.GetSelectedObject6(1, -1)
       

        Set swFeatData = swFeat.GetDefinition
        swFeatData.AccessSelections Part, Nothing
       

        boolstatus = Part.Extension.SelectByID2("", "VERTEX", -5.38403893475499E-02, -1.00654290631334E-02, 0.205954465964501, False, 0, Nothing, 0)
   

        Dim refPoint As Variant
        Set refPoint = Part.SelectionManager.GetSelectedObject6(1, -1)
        swFeatData.ReferencePoint = refPoint
       

        swFeat.ModifyDefinition swFeatData, Part, Nothing
   

End Sub

 



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