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Inserting a Part into Another Part

Use Insert Part to insert a base part into another part document.

When you insert a part into another part:
  • The part into which you insert it becomes a multibody part.
  • The part you insert becomes a solid body.
  • If the inserted part contains mate references, you can use them to position the inserted part. A Body-Move/Copy feature is added to the FeatureManager design tree. You can move and rotate the body after you place it.

To insert a part:

  1. With a part document open, click Insert Part (Features toolbar) or Insert > Part.
  2. Browse to a part document and click Open.

    The Insert Part PropertyManager appears.

  3. Under Transfer, select any combination of items from the inserted part to be included in the derived part. You can include items such as custom properties, cut-list properties, sketches, and model dimensions.

    All transferred elements of the inserted part are placed in folders under the inserted part in the FeatureManager design tree.

  4. Under Locate Part, select Locate part with Move/Copy feature to define a location for the inserted part in the Locate Part PropertyManager.
  5. Optionally, if you want to independently edit the features of the inserted part without affecting the original part, under Link, click Break link to original part.

    You can also break the link to the original part later by listing the derived part's external references and selecting Break All. Once you break the link to the original, you cannot restore it.

  6. Click .

    After you insert a part, you can move, copy, rotate, or mate it using Move/Copy Bodies (Features toolbar).

To change the configuration of the inserted part:

  1. Right-click the part and select List External Refs.
  2. Select a configuration in Configuration Name, and click OK.
    You can also control the configuration with a design table. See Base Parts in Configurations.

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