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Create and Edit Circular Sketch Pattern Example (C#)

This example shows how to create and edit a circular sketch pattern.

// Preconditions: Verify that the specified part document template
// exists.
// Postconditions:
// 1. Opens a new part document and creates a sketch.
// 2. Inserts a circular sketch pattern of four instances.
// 3. Closes the sketch.
// 4. Opens the circular sketch pattern for editing.
// 5. Deletes an instance of circular sketch pattern, leaving
//    three instances.
// 6. Examine the graphics area.

using SolidWorks.Interop.sldworks;

using SolidWorks.Interop.swconst;

using System;

namespace CreateEditCircularPattern_CSharp.csproj


    partial class SolidWorksMacro


        public void Main()


            ModelDoc2 swModel = default(ModelDoc2);

            ModelDocExtension swModelDocExt = default(ModelDocExtension);

            SketchManager swSketchMgr = default(SketchManager);

            SketchSegment swSketchSegment = default(SketchSegment);

            object vSkLines = null;

            bool boolstatus = false;

            int longstatus = 0;

            // Reset the counts for untitled documents for this macro

            swApp.ResetUntitledCount(0, 0, 0);

            // Create a part document

            swModel = (ModelDoc2)swApp.NewDocument("C:\\Documents and Settings\\All Users\\Application Data\\SOLIDWORKS\\SOLIDWORKS 2010\\templates\\Part.prtdot", 0, 0, 0);

            swApp.ActivateDoc2("Part1", false, ref longstatus);

            swModel = (ModelDoc2)swApp.ActiveDoc;

            swSketchMgr = swModel.SketchManager;

            swModelDocExt = swModel.Extension;

            // Sketch a circle

            swSketchSegment = swSketchMgr.CreateCircle(0.0, 0.0, 0.0, 0.045549, 0.013926, 0.0);

            // Clear any selections and change

            // the view orientation to Front


            swModel.ShowNamedView2("*Front", 1);

            // Create a rectangle

            vSkLines = swSketchMgr.CreateCornerRectangle(-0.005867589431389, 0.03694408160504, 0, 0.004563680668858, 0.02673012963188, 0);

            // Create a circular sketch pattern

            // using the rectangle

            boolstatus = swSketchMgr.CreateCircularSketchStepAndRepeat(0.03184378021964, 4.732863934409, 4, 1.570796326795, true, "", true, true, true);


            // Close the sketch and rebuild


            // Select an entity in the circular sketch pattern

            // and open the circular sketch pattern to edit it

            boolstatus = swModelDocExt.SelectByID2("Line1@Sketch1", "EXTSKETCHSEGMENT", -0.002390499397973, 0.03694408160504, 0, false, 0, null, 0);


            // Delete an instance of the circular

            // sketch pattern and close the sketch

            boolstatus = swSketchMgr.EditCircularSketchStepAndRepeat(0.03184378021964, 4.732863934409, 3, 1.570796326795, true, "", true, true, true, "Line2_Line1_Line4_Line3_"





        public SldWorks swApp;



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