Create Linear Dynamic Time History Study Example (VBA)

This example shows how to create a linear dynamic study with a modal time history analysis and get some study options.

'---------------------------------------------------------------------------
' Preconditions:
' 1. Add the SOLIDWORKS Simulation add-in
'    (in SOLIDWORKS, click Tools > Add-ins > SOLIDWORKS Simulation).
' 2. Add the SOLIDWORKS Simulation type library as a reference
'    (in the IDE, click Tools > References > SOLIDWORKS
'    Simulation version type library).
' 3. Ensure that the specified file to open exists.
' 4. Ensure that the c:\temp folder exists.
'
' Postconditions:
' 1. Opens the specified file.
' 2. Creates a linear dynamic study for model time history analysis.
' 3. Runs the analysis.
' 4. Prints some study options and results to the Immediate window.
' 5. Saves the solution step, displacement, velocity,
'    and stress result files to c:\temp.
'
' NOTE: Because the model is used elsewhere, do not save any changes.
'---------------------------------------------------------------------------
Option Explicit
Sub main()
    Dim SwApp As SldWorks.SldWorks
    Dim Part As SldWorks.ModelDoc2
    Dim COSMOSWORKS As CosmosWorksLib.COSMOSWORKS
    Dim CWAddinCallBack As CosmosWorksLib.CWAddinCallBack
    Dim ActDoc As CosmosWorksLib.CWModelDoc
    Dim StudyMngr As CosmosWorksLib.CWStudyManager
    Dim Study As CosmosWorksLib.CWStudy
    Dim ShellMgr As CosmosWorksLib.CWShellManager
    Dim ShellMat As CosmosWorksLib.CWMaterial
    Dim LBCMgr As CosmosWorksLib.CWLoadsAndRestraintsManager
    Dim DynStudyOptions As CosmosWorksLib.CWDynamicStudyOptions
    Dim CWBaseExcitationEntity As Object
    Dim CWDirectionEntity As Object
    Dim longstatus As Long
    Dim longwarnings As Long
    Dim errCode As Long
    Dim boolstatus As Boolean
    Dim nStep As Long
    Dim pDisp5 As Object
    Dim DispArray1 As Variant, DispArray3 As Variant
    Dim Disp As Variant, Stress As Variant, Velocity As Variant, Acceleration As Variant
    Dim sStudyName As String
    Dim ResultOptions As CosmosWorksLib.CWStudyResultOptions
    Dim i As Long
    Dim freqOption As Long
    Dim freqValue As Double
    Dim bChecked As Long
    Dim forces2 As Variant
    Dim selectedAndModelReactionFM As Variant
    Dim selectedOnlyReactionFM As Variant
    Dim CWFeatObj1 As CosmosWorksLib.CWShell
    Dim CWFeatObj3 As CosmosWorksLib.CWRestraint
    Dim CWFeatObj4 As CosmosWorksLib.CWMesh
    Dim CWFeatObj5 As CosmosWorksLib.CWResults
    Dim CWFeatObj6 As CosmosWorksLib.CWDynamicInitialCondition
    Dim param As Long
    Dim sParam As String
    Dim dParam As Double
    Dim dStartTime As Double, dEndTime As Double, dTimeInc As Double

    'Tolerances and baselines
    Const MeshEleSize   As Double = 26.5868077635828 'mm
    Const MeshTol       As Double = 1.32934038817914 'mm
    'Connect to SOLIDWORKS
    Set SwApp = Application.SldWorks
    If SwApp Is Nothing Then Exit Sub
    'Open document
    Set Part = SwApp.OpenDoc6("C:\Program Files\SOLIDWORKS Corp\SOLIDWORKS\samples\tutorial\api\lineardynamic.SLDPRT", swDocPART, swOpenDocOptions_Silent, "", longstatus, longwarnings)
    If Part Is Nothing Then ErrorMsg SwApp, "Failed to open lineardynamic.SLDPRT"
    'Add-in callback
    Set CWAddinCallBack = SwApp.GetAddInObject("CosmosWorks.CosmosWorks")
    If CWAddinCallBack Is Nothing Then ErrorMsg SwApp, "Failed to get CwAddincallback object"
    Set COSMOSWORKS = CWAddinCallBack.COSMOSWORKS
    If COSMOSWORKS Is Nothing Then ErrorMsg SwApp, "Failed to get CosmosWorks object"
    'Get active document
    Set ActDoc = COSMOSWORKS.ActiveDoc()
    If ActDoc Is Nothing Then ErrorMsg SwApp, "Failed to get active document"
    'Create a dynamic random vibration study
    Set StudyMngr = ActDoc.StudyManager()
    If StudyMngr Is Nothing Then ErrorMsg SwApp, "Failed to get study manager object"
    sStudyName = "Dynamic_Modal_Time_History"
    Set Study = StudyMngr.CreateNewStudy3(sStudyName, swsAnalysisStudyTypeDynamic, swsDynamicAnalysisSubTypeTransient, errCode)
    Debug.Print "Linear dynamic study with modal time history analysis"
    Debug.Print ""
    Debug.Print "Study configuration name is " & Study.ConfigurationName
    Debug.Print "Dynamic analysis subtype as defined in swsAnalysisStudyType_e is " & Study.DynamicAnalysisSubType
   

    Debug.Print "Dynamic study options..."
    Set DynStudyOptions = Study.DynamicStudyOptions
    errCode = DynStudyOptions.GetFrequencyOption2(freqOption, freqValue)
    Debug.Print "  Frequency option (0=number of frequencies, 1=upper bound): " & freqOption
    Debug.Print "  No. of frequencies or upper-bound frequency: " & freqValue
    errCode = DynStudyOptions.GetFrequencyShiftOption2(bChecked, freqValue)
    Debug.Print "  Is frequency shift enabled (0=no, 1=yes)? " & bChecked
    Debug.Print "  Frequency shift: " & freqValue
    errCode = DynStudyOptions.SetIncompatibleBondingOption2(0) ' automatic
    errCode = DynStudyOptions.SetUseSoftSpring2(0) ' do not use soft springs to stabilize model
    errCode = DynStudyOptions.SetResultFolderPath2("c:\temp")
    DynStudyOptions.SolverType = 2 ' FFEPlus
    errCode = DynStudyOptions.GetTimeHistoryDeadLoadOptions2(param, sParam, dParam)
    Debug.Print "  Get dead loads from a static study (1 to get them, 0 to not): " & param
    Debug.Print "  Name of static study from which to get dead loads: " & sParam
    Debug.Print "  Multiplication factor: " & dParam
    errCode = DynStudyOptions.GetTimeHistoryFirstIntegrationParameter2(dParam)
    Debug.Print "  First integration parameter: " & dParam
    errCode = DynStudyOptions.GetTimeHistoryIntegrationMethod2(param)
    Debug.Print "  Integration method as defined in swsTimeIntegrationMethod_e: " & param
    errCode = DynStudyOptions.GetTimeHistorySecondIntegrationParameter2(dParam)
    Debug.Print "  Second integration parameter): " & dParam
    errCode = DynStudyOptions.GetTimeHistoryTimeRangeValues2(dStartTime, dEndTime, dTimeInc)
    Debug.Print "  Use the material damping ratio? (1 to use, 0 to not): " & dStartTime
    Debug.Print "  Use the material damping ratio? (1 to use, 0 to not): " & dEndTime
    Debug.Print "  Use the material damping ratio? (1 to use, 0 to not): " & dTimeInc
    errCode = DynStudyOptions.GetTimeHistoryWilsonTheta2(dParam)
    Debug.Print "  Theta value: " & param
    Debug.Print ""
   

    'Set study result options
    Debug.Print "Study result options..."
    Set ResultOptions = Study.StudyResultOptions
    ResultOptions.SaveResultsForSolutionStepsOption = 1 ' save solution step results
    ResultOptions.SaveDisplacementsAndVelocitiesOption = 1 ' save displacements and velocities
    ResultOptions.SaveStresses = 1 ' save stresses
    'Solution step set #1
    errCode = ResultOptions.SetSolutionStepsSetInformation(1, 10, 100, 3)
    Debug.Print "  Set solution steps set #1 (10-100, inc=3)? (0=success): " & errCode
    'Solution step set #3
    errCode = ResultOptions.SetSolutionStepsSetInformation(3, 100, 1000, 5)
    Debug.Print "  Set solution steps set #3 (100-1000, inc=5)? (0=success): " & errCode
    Debug.Print ""
    Dim PID       As Variant
    Dim SelObj    As Object
    Dim obj       As Object
    'Get face by persistent ID
    boolstatus = Part.Extension.SelectByID2("", "FACE", 0.367377178180561, 1.53999999998859E-02, -0.443699715030164, False, 0, Nothing, 0)
    Set obj = Part.SelectionManager.GetSelectedObject6(1, -1)
    PID = Part.Extension.GetPersistReference3(obj)
    Set SelObj = Part.Extension.GetObjectByPersistReference3((PID), errCode)
    DispArray1 = Array(SelObj) 'Face
    'Get edge by persistent ID
    boolstatus = Part.Extension.SelectByID2("", "EDGE", 0.473843326221299, 1.60904480509885E-02, -6.90335842989498E-04, False, 0, Nothing, 0)
    Set obj = Part.SelectionManager.GetSelectedObject6(1, -1)
    PID = Part.Extension.GetPersistReference3(obj)
    Set CWBaseExcitationEntity = Part.Extension.GetObjectByPersistReference3((PID), errCode)
    DispArray3 = Array(CWBaseExcitationEntity) 'Edge
    'Get Axis1 reference geometry by persistent ID
    boolstatus = Part.Extension.SelectByID2("Axis1", "AXIS", -3.20045390890095E-02, 6.39408825367532E-02, -3.19259521004658E-02, False, 0, Nothing, 0)
    Set obj = Part.SelectionManager.GetSelectedObject6(1, -1)
    PID = Part.Extension.GetPersistReference3(obj)
    Set CWDirectionEntity = Part.Extension.GetObjectByPersistReference3((PID), errCode)
    Set pDisp5 = CWDirectionEntity
    'Add materials
    Set ShellMgr = Study.ShellManager
    If ShellMgr Is Nothing Then ErrorMsg SwApp, "Failed to get shell manager object"
    Set CWFeatObj1 = ShellMgr.GetShellAt(0, errCode)
    If errCode <> 0 Then ErrorMsg SwApp, "Failed to get shell component"
    Set ShellMat = CWFeatObj1.GetDefaultMaterial
    ShellMat.MaterialUnits = 0
    Call ShellMat.SetPropertyByName("EX", 2000000000000#, 0)
    Call ShellMat.SetPropertyByName("NUXY", 0.25, 0)
    errCode = CWFeatObj1.SetShellMaterial(ShellMat)
    If errCode <> 0 Then ErrorMsg SwApp, "Failed to apply material"
    Call CWFeatObj1.ShellBeginEdit
    CWFeatObj1.Formulation = 1 ' thick shell
    CWFeatObj1.ShellUnit = 1 ' centimeters
    CWFeatObj1.ShellThickness = 5 ' 5 cm
    CWFeatObj1.ShellOffsetOption = 3 ' specify reference surface
    CWFeatObj1.ShellOffsetValue = 0.3
    errCode = CWFeatObj1.ShellEndEdit
    If errCode <> 0 Then ErrorMsg SwApp, "Failed to create shell"
    Set CWFeatObj1 = Nothing
    'Get loads and restraints manager
    Set LBCMgr = Study.LoadsAndRestraintsManager
    If LBCMgr Is Nothing Then ErrorMsg SwApp, "Failed to get loads and restraints manager."
    Debug.Print " "
    'Add a restraint
    Set CWFeatObj3 = LBCMgr.AddRestraint(0, (DispArray3), pDisp5, errCode)
    If errCode <> 0 Then ErrorMsg SwApp, "Failed to create restraint"
    Call CWFeatObj3.RestraintBeginEdit
    Call CWFeatObj3.SetTranslationComponentsValues(0, 0, 1, 0#, 0#, 0#)
    Call CWFeatObj3.SetRotationComponentsValues(0, 0, 0, 0#, 0#, 0#)
    CWFeatObj3.Unit = 2
    errCode = CWFeatObj3.RestraintEndEdit
    If errCode <> 0 Then ErrorMsg SwApp, "Restraint end-edit failed"
    'Add an initial condition
    Set CWFeatObj6 = LBCMgr.AddInitialConditionForDynamicStudy(swsDynamicInitialConditionType_Displacement, swsSelectionFaceEdgeVertexPoint, (DispArray1), CWBaseExcitationEntity, swsLinearUnitMillimeters, 0, 0, 0, 0, 1, 10#, errCode)
    If errCode <> 0 Then ErrorMsg SwApp, "Failed to add initial condition"
    'Create mesh
    Set CWFeatObj4 = Study.Mesh
    If CWFeatObj4 Is Nothing Then ErrorMsg SwApp, "Failed to create mesh object"
    CWFeatObj4.MesherType = 0 ' standard
    CWFeatObj4.Quality = 1 ' high
    errCode = Study.CreateMesh(0, MeshEleSize, MeshTol)
    If errCode <> 0 Then ErrorMsg SwApp, "Failed to create mesh"
    Debug.Print "Worst Jacobian ratio for the mesh: " & CWFeatObj4.GetWorstJacobianRatio
    Debug.Print ""
   

    'Run analysis
    Debug.Print "Running the analysis"
    Debug.Print ""
    errCode = Study.RunAnalysis
    If errCode <> 0 Then ErrorMsg SwApp, "Analysis failed with error code " & errCode & " - " & ProcErrCode(errCode)
    'Get results
    Set CWFeatObj5 = Study.Results
    If CWFeatObj5 Is Nothing Then ErrorMsg SwApp, "Failed to get results object"
    Debug.Print "Study results..."
    nStep = CWFeatObj5.GetMaximumAvailableSteps
    Debug.Print "  Maximum available steps: " & nStep
    'Get algebraic minimum/maximum resultant displacements
    Disp = CWFeatObj5.GetMinMaxDisplacement(3, nStep, Nothing, 0, errCode)
    If errCode <> 0 Then ErrorMsg SwApp, "Failed to get displacement results"
    Debug.Print "  Min/max URES resultant displacements (Node, Min, Node, Max):"
    For i = 0 To UBound(Disp)
        Debug.Print ("  * " & Disp(i))
    Next
    Debug.Print ""
    'Get algebraic minimum/maximum von Mises stresses
    Stress = CWFeatObj5.GetMinMaxStress(9, 0, nStep, Nothing, 3, errCode)
    If errCode <> 0 Then ErrorMsg SwApp, "Failed to get stress results"
    Debug.Print "  Algebraic min/max von Mises stresses (Node, Min, Node, Max):"
    For i = 0 To UBound(Stress)
        Debug.Print ("  * " & Stress(i))
    Next
    Debug.Print ""
    'Get algebraic minimum/maximum velocities
    Velocity = CWFeatObj5.GetMinMaxVelocity(0, nStep, CWDirectionEntity, 0, errCode)
    If errCode <> 0 Then ErrorMsg SwApp, "Failed to get velocity results"
    Debug.Print "  Algebraic min/max velocities (Node, Min, Node, Max):"
    For i = 0 To UBound(Velocity)
        Debug.Print ("  * " & Velocity(i))
    Next
    Debug.Print ""
    'Get algebraic minimum/maximum accelerations
    Acceleration = CWFeatObj5.GetMinMaxAcceleration(0, nStep, CWDirectionEntity, 0, errCode)
    If errCode <> 0 Then ErrorMsg SwApp, "Failed to get acceleration results"
    Debug.Print "  Algebraic min/max accelerations (Node, Min, Node, Max):"
    For i = 0 To UBound(Acceleration)
        Debug.Print ("  * " & Acceleration(i))
    Next
    'Reaction forces and moments for entire model and selected face at solution step 31
    forces2 = CWFeatObj5.GetReactionForcesAndMomentsWithSelections(31, Nothing, swsForceUnitNOrNm, (DispArray1), selectedAndModelReactionFM, selectedOnlyReactionFM, errCode)
    If errCode <> 0 Then ErrorMsg SwApp, "Failed to get reaction forces and moments"
    Debug.Print "  Reaction forces (N) and moments (N-m) for selected face at solution step 1 "
    Debug.Print "  {xcoord_force, ycoord_force, zcoord_force, resultant_force, "
    Debug.Print "   xcoord_moment, ycoord_moment, zcoord_moment, resultant_moment}:"
    For i = 0 To UBound(selectedOnlyReactionFM)
        Debug.Print ("  * " & selectedOnlyReactionFM(i))
    Next
End Sub
Sub ErrorMsg(SwApp As SldWorks.SldWorks, Message As String)
    SwApp.SendMsgToUser2 Message, 0, 0
    SwApp.RecordLine "'*** WARNING - General"
    SwApp.RecordLine "'*** " & Message
    SwApp.RecordLine ""
End Sub
' Process error code as defined in swsRunAnalysisError_e
Function ProcErrCode(errCode As Long) As String
    Select Case errCode
            Case 0
                ProcErrCode = "Successful"
            Case 1
                ProcErrCode = "Use high quality mesh"
            Case 2
                ProcErrCode = "Rigid virtual wall contact must be defined"
            Case 3
                ProcErrCode = "Define initial temperatures to perform transient thermal analysis"
            Case 4
                ProcErrCode = "Multiple loads on an entity should use the same time curve"
            Case 5
                ProcErrCode = "Drop test study is not set up"
            Case 6
                ProcErrCode = "One or more static studies need to perform fatigue analysis"
            Case 7
                ProcErrCode = "No fatigue event defined"
            Case 8
                ProcErrCode = "All loads should be either time-dependent or amplitude only"
            Case 9
                ProcErrCode = "No SN curve available"
            Case 11
                ProcErrCode = "The mesh is not identical for static studies used in different events"
            Case 12
                ProcErrCode = "No valid shell defined"
            Case 13
                ProcErrCode = "Elastic modulus (EX) material property is not defined"
            Case 14
                ProcErrCode = "Elastic modulus (EX) should be > 0.0"
            Case 15
                ProcErrCode = "Poisson's Ratio should be less than 0.5"
            Case 16
                ProcErrCode = "Thermal conductivity is not defined"
            Case 17
                ProcErrCode = "Creep option for material works only in force control method"
            Case 18
                ProcErrCode = "Material is not defined for one or more shells"
            Case 19
                ProcErrCode = "Material is not defined"
            Case 20
                ProcErrCode = "Material is not defined for one or more components"
            Case 21
                ProcErrCode = "No solid body to process"
            Case 22
                ProcErrCode = "Authorization failed for this analysis type"
            Case 23
                ProcErrCode = "Mesh not found"
            Case 24
                ProcErrCode = "Analysis failed"
            Case Else
                ProcErrCode = "Unknown error condition"
    End Select
End Function