Hole Wizard Type PropertyManager

To open this PropertyManager:

Create a part, select a surface, and click Hole Wizard (Features toolbar) or Insert > Features > Hole > Wizard.

You can also open the Hole Wizard Type PropertyManager from an assembly.

Favorite

Manage a list of styles for Hole Wizard holes that you can reuse in models.

	Apply Defaults/No Favorite	Resets to No Favorite Selected and the default settings.
	Add or Update a Favorite	Adds the selected Hole Wizard hole to the Favorites list. To add a style, click , type a name, then click OK. To update a style, edit the properties on the Type, select the hole in Favorites, then click and enter a new or existing name.
	Delete Favorite	Deletes the selected style.
	Save Favorite	Saves the selected style. Click this option, then browse to a folder. You can edit the file name.
	Load Favorite	Loads the style. Click this option, browse to a folder, then select a style.

Hole Type and Hole Specifications

The Hole Specification options vary depending on the Hole Type. Use the PropertyManager images and descriptive text to set the options.

	Counterbore
	Countersink
	Hole
	Straight Tap
	Tapered Tap
	Legacy Hole	Holes created prior to the SOLIDWORKS 2000 release
	Counterbore Slot	Specifies slot holes of length Slot Length .
	Countersink Slot
	Slot
	Standard	Specifies the hole standard. For example, select ANSI Metric or JIS.
	Type	Specifies drill sizes, tap drills, dowel holes, or screw clearance. For example, select All Drill Sizes or Screw Clearances.
	Filter	Available for PEM® Inch or PEM® Metric standards. Filters the selections availalable for Type.
	Size	Specifies the fastener size.
	Show decimal values	For straight holes or slots, displays decimal hole size values for all, letter, number, or fractional drill sizes.
	Fit (Counterbore and Countersink only)	Specifies the fastener fit: Close, Normal, or Loose.
	Show Custom Sizing	Sizing options vary depending on the hole type. Use the PropertyManager images and descriptive text to set the options such as diameter, depth, and angle at bottom. You can override the value in the boxes. To revert to the default values, click Restore Default Values. The background color of the boxes is white for the default value, and yellow for the override value.
	Configurations	Specify the configuration to modify when a model has configurations requiring different Hole Wizard sizes. You can also use a design table.

Section Dimensions

(Legacy Holes only). Double-click a Value to edit it.

End Condition

The End Condition options vary depending on the hole type. Use the PropertyManager images and descriptive text to set the options. Select an end condition from the list. If necessary, click Reverse Direction . Set other end condition options depending on the condition and hole type.

	Blind Hole Depth (Blind only)	Set the hole depth. For tap holes you can set the thread depth and type. For pipe tap holes, you can set the thread depth. The Automatically Calculate Depth icon is selected by default. If you select a different hole Size under Hole Specifications, the end condition depths update automatically. If you clear Automatically Calculate Depth , the end condition no longer updates automatically if you change the Size. You can override the value in the boxes. To revert to the default values, click Restore Default Values. The background color of the boxes is white for the default value, and yellow for the override value.
	Vertex (Up to Vertex only)	Select a vertex.
	Face/Surface/Plane (Up to Surface and Offset from Surface only).	Select a face, surface, or plane.
	Offset Distance (Offset from Surface only)	Set the offset distance from the selected face, surface, or plane.

Options

The Options vary depending on the hole type. Use the PropertyManager images and descriptive text to set the options such as:

Head clearance	For Counterbore, setting a Head clearance value other than 0.00 adds that value above the fastener head using the document units.
under head, near, and far side diameter and angle
cosmetic thread and thread class.	Select a thread option:
	Tap drill diameter	Cosmetic thread	Remove thread
	Cuts the hole at the tap drill diameter.	Cuts the hole at the tap drill diameter with a cosmetic thread. With thread callout. Adds an annotation for drawings only.	Cuts the hole at the thread diameter.

Feature Scope

Specifies which bodies or components you want the feature to affect.