Adding a Corner Relief

You can add a corner relief to a single sheet metal body.

1. Click Corner Relief (Sheet Metal toolbar) or Insert > Sheet Metal > Corner Relief.
2. In the Corner Relief PropertyManager, under Scope, select the sheet metal body to which to apply the corner relief.
3. Under Corners, click Collect all corners to list all corners in the sheet metal body.

   If you list multiple corners, you can specify multiple corner relief treatments.

   When you select a corner in the Corners section, the faces that define the corner are shown in the Define Corner section and the corner is highlighted in the graphics area.

4. To add an individual corner instead of collecting all corners, in the Define Corner section, select the faces that define the corner and click New Corner.

   The corner is added to the list in the Corners section.

5. With a corner selected, under Relief Options, select the type of relief to apply.

   The relief type determines other options you can specify:

   Available options	Rectangular	Circular	Tear	Obround	Constant Width
   Centered on bend lines	Yes	Yes	NA	Yes	NA
   Slot Length	Yes	Yes	NA	Yes	NA
   Ratio to thickness	Yes	Yes	NA	Yes	NA
   Tangent to bend	Yes	Yes	NA	NA	NA
   Add filleted corners	Yes	NA	NA	NA	NA
   Corner Fillets	Yes	NA	NA	NA	NA
   Slot Width	NA	Yes	NA	Yes	NA
   Narrow corner	Yes	Yes	NA	Yes	NA

   Previews of your choices appear in the graphics area.

6. Click .
7. Click Flatten (Sheet Metal toolbar) to see how the corner relief appears in the flattened sheet metal part.