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Selecting Contours

Select sketch contours and model edges, and apply features to them. This allows you to use a partial sketch to create features.

A tooltip appears when you cannot select a contour because:
  • The part has too many edges.
  • Edges are created on offset planes.
  • Edges are chamfered.
  • Edges are filleted.

Contour selection is also restricted as follows:

  • When reusing a sketch, you can select only on the original face. If, for example, part of the face has been extruded, the tool does not recognize the new face.
  • You can select contours only on the face with the sketch. If, for example, the face with the sketch is cut by a solid object (as shown below), the tool can select the part of the face still visible but does not recognize the solid object.
    Contour_Select_Solid.gif
When creating lofts with 3D sketch contours as opposed to individual sketches, you can select one or more contours.

To select and extrude contours:

  1. In an active sketch, select a feature to apply the selected contours. For example, click one of the following to display the appropriate PropertyManager:
    • Extruded Boss/Base Tool_Extruded_Boss_Base_Features.gif (Features toolbar)
    • Revolved Boss/Base Tool_Revolved_Boss_Base_Features.gif (Features toolbar)
    contour_select_sketch_00.gif
  2. In the graphics area, use the pointer pointer_contour_select.gif to select a contour for Selected Contours.

    The contour can include model edges.

    To select multiple contours, hold down Ctrl.

    contour_select_sketch_01.gif contour_select_sketch_02.gif
  3. Click PM_OK.gif to apply to the selected contours.

    contour_select_sketch_03.gif
    contour_select_sketch_04.gif
    Extrude Revolve


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