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Insert Cavity Example (VB.NET)

This example shows how to insert a cavity in a mold base.

' Preconditions:
' 1. Create a new folder and copy public_documents\tutorial\molds\telephone.sldprt 
'    to that folder.
' 2. Click File > New > Part > OK to create a new part document.
'    a. Insert a sketch of a rectangle with a length of 240 mm and width of 350 mm.
'    b. Using the sketch, create a boss extrude feature with a depth of 160 mm.
'    c. Save the part as telephoneMoldBase.sldprt in the folder created in step 1.
' 3. Click File > New > Assembly > OK to create a new assembly document.
'    a. Click telephoneMoldBase in Part/Assembly to Insert in the PropertyManager page.
'    b. Click OK.
'    c. Click Insert Components on the Assembly toolbar, click Browse in
'       Part/Assembly to Insert, click telephone.sldprt located in the folder 
'       created in step 1, and click Open.
'    d. Drop telephone.sldprt in the graphics area.
'    e. Click View > Display > Hidden Lines Visible.
'    f. In the FeatureManager design tree, click telephone<1> and click Move Component
'       in the Assembly toolbar.
'    g. Move telephone<1> into the center of telephoneMoldBase<1> and click OK.
'       TIP: Change the view orientation to Top and Front to help center telephone<1>.
'    h. Click File > Save All > Rebuild and save the document (recommended)
'       navigate to the folder created in step 1, type AssemInterim.sldasm in 
'       File name, and click Save.
' 4. Click telephoneMoldBase<1> in the FeatureManager design tree.
' 5. Ctrl+click telephone<1> in the FeatureManager design tree.
' Postconditions:
' 1. Creates Cavity1 in telphoneMoldBase<1>.
' 2. Expand telephoneMoldBase<1> to verify step 1.
Imports SolidWorks.Interop.sldworks
Imports SolidWorks.Interop.swconst
Imports System.Runtime.InteropServices
Imports System
Partial Class SolidWorksMacro
    Public Sub main()
        Dim swModel As ModelDoc2
        Dim swSelMgr As SelectionMgr
        Dim swAssy As AssemblyDoc
        Dim swMoldBaseComp As Component2
        Dim swCoreComp1 As Component2
        Dim nRetval As Integer
        Dim nInfo As Integer
        Dim bRet As Boolean
        swModel = swApp.ActiveDoc
        swAssy = swModel
        swSelMgr = swModel.SelectionManager
        swMoldBaseComp = swSelMgr.GetSelectedObjectsComponent2(1)
        swCoreComp1 = swSelMgr.GetSelectedObjectsComponent2(2)


        bRet = swMoldBaseComp.Select2(False, 0)
        nRetval = swAssy.EditPart2(TrueTrue, nInfo)
        bRet = swCoreComp1.Select2(True, 0)
        swAssy.InsertCavity4(0.0#, 0, 0.0#, True, swCavityScaleType_e.swAboutCentroid, 0)
    End Sub
    ''' <summary>
    ''' The SldWorks swApp variable is pre-assigned for you.
    ''' </summary>
    Public swApp As SldWorks
End Class


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