Function CreateEllipse( _
   ByVal XC As System.Double, _
   ByVal YC As System.Double, _
   ByVal Zc As System.Double, _
   ByVal XMajor As System.Double, _
   ByVal YMajor As System.Double, _
   ByVal ZMajor As System.Double, _
   ByVal XMinor As System.Double, _
   ByVal YMinor As System.Double, _
   ByVal ZMinor As System.Double _
) As SketchSegment

Dim instance As ISketchManager
Dim XC As System.Double
Dim YC As System.Double
Dim Zc As System.Double
Dim XMajor As System.Double
Dim YMajor As System.Double
Dim ZMajor As System.Double
Dim XMinor As System.Double
Dim YMinor As System.Double
Dim ZMinor As System.Double
Dim value As SketchSegment
 
value = instance.CreateEllipse(XC, YC, Zc, XMajor, YMajor, ZMajor, XMinor, YMinor, ZMinor)

SketchSegment CreateEllipse( 
   System.double XC,
   System.double YC,
   System.double Zc,
   System.double XMajor,
   System.double YMajor,
   System.double ZMajor,
   System.double XMinor,
   System.double YMinor,
   System.double ZMinor
)

SketchSegment^ CreateEllipse( 
&   System.double XC,
&   System.double YC,
&   System.double Zc,
&   System.double XMajor,
&   System.double YMajor,
&   System.double ZMajor,
&   System.double XMinor,
&   System.double YMinor,
&   System.double ZMinor
) 

Parameters

XC

X coordinate of the ellipse center point

YC

Y coordinate of the ellipse center point

Zc

Z coordinate of the ellipse center point

XMajor

X coordinate of the point on the ellipse that is on the major axis

YMajor

Y coordinate of the point on the ellipse that is on the major axis

ZMajor

Z coordinate of the point on the ellipse that is on the major axis

XMinor

X coordinate of the point on the ellipse that is on the minor axis

YMinor

Y coordinate of the point on the ellipse that is on the minor axis

ZMinor

Z coordinate of the point on the ellipse that is on the minor axis

Return Value

This method creates a full ellipse in the active 2D sketch. If a sketch is not active, then a new sketch is created. You can check for an active sketch using ISketchManager::ActiveSketch.

ISketchManager::AddToDB and ISketchManager::DisplayWhenAdded increase performance during entity creation by adding entities directly to the SOLIDWORKS database.

ISketchManager::AddToDB also avoids some of the peculiarities involved with creating entities via the user interface, such as inferencing, automatic relations, and snapping to the grid. Adding entities directly to the database also significantly increases the performance of this method. When you are done creating entities, it is important to ISketchManager::AddToDB(False), to restore SOLIDWORKS to its normal operating mode.

This method also works with ISketchManager::DisplayWhenAdded. If you have called ISketchManager::AddToDB(True), additional performance can be gained by calling ISketchManager::DisplayWhenAdded(False) to disable immediate display of entities as they are added to the database. When you are done creating all of your sketch entities, you must redraw your document window (see IModelView::GraphicsRedraw or IModelView::IGraphicsRedraw) to see the entities you added. You should also restore the original display settings by calling ISketchManager::DisplayWhenAdded(True).

To create a partial ellipse, use ISketchManager::CreateEllipticalArc.