Thread PropertyManager

Specify the following properties when inserting a thread in a part.

The Thread tool does not autosize the thread to the model. This tool accelerates creating an extruded or cut thread on a hole or shaft, based on the selected profile.

To open the Thread PropertyManager:

  1. On a cylindrical feature (a boss, a cut, or a hole), select the circular edge where the thread begins.
  2. Click Thread (Features toolbar), or click Insert > Features > Thread .

Configurations

You can apply various thread parameters to different configurations. Click the down arrow next to All Configurations and select one of the following:
This Configuration Applies the value to the active configuration only.
All Configurations Applies the value to all configurations in the model.
Specify Configuration Applies the value to the active configuration and any other configurations you select.
select_edge_cir.png Edge of Cylinder Select a circular edge in the graphics area.
Optional Start Location Select a starting point for the helix such as a vertex (sketch, model, or reference points), edge (sketch, model or reference axis), plane, or planar surface. This selection is optional if the edge is a planar circular edge, but required, if not.
  Offset  
  Reverse Direction Flips the offset direction to the opposite side of the selected reference.
Start Angle Defines a starting location for the helix. The start angle must be positive. Enter a value or start with = (equal sign) to create an equation.

End Condition

Reverse Direction Select one of the following:

Blind

Specify a value for Depth. Terminates the thread at a specific distance from the starting location, taking into account any offset.

Revolutions

Terminates the helix a specific number of revolutions from the starting location, taking into account any offset. The value must be positive and greater than 0.00. Enter a value or start with = (equal sign) to create an equation.

Up to Selection

Select a vertex (sketch, model, or reference points), edge (sketch, model or reference axis), plane, or planar surface. A plane, planar face, or edge must be parallel to the circular edge (i.e. perpendicular to the thread axis).

  Maintain thread length Keeps the thread at a constant length from the start surface. Only displays if Surface Offset is set and End Condition is set to Blind or Revolutions.

Specification

The Thread tool Type and Size profiles are nominal thread profiles only. Do not use them for production-quality threads. To create production-quality threads, modify the nominal profiles to meet your design requirements.
  Type Select a thread type. Displays library part files installed in C:\ProgramData\SolidWorks\SOLIDWORKS YYYY\Thread Profiles.
  Size Select a thread size. Displays configurations in the library part file from the Type list.
Override Diameter Click to manually override the diameter of the cylindrical face or helix. Enter a value or start with = (equal sign) to create an equation.
Override Pitch Click to manually override the pitch of the helix. Enter a value or start with = (equal sign) to create an equation.
  Thread Method Select one of the following:

Cut Thread

Creates a swept cut using the profile.

Extrude Thread

Creates a swept boss using the profile.
  Mirror Profile Flips the profile of the helix about its horizontal axis or vertical axis. Select one of the following:

Mirror horizontally

Mirror vertically

Rotation Angle Rotates the helix by a set number of degrees. Enter a value or start with = (equal sign) to create an equation.
  Locate Profile Zooms to the profile so you can change any sketch points or vertices in the sketch profile.

Thread Options

  Right-hand thread Creates threads in a clockwise direction.
  Left-hand thread Creates threads in a counter clockwise direction.
  Multiple Start Sets the number of starts to define the number of times the thread is created in an evenly-spaced circular pattern around the hole or shaft. The image shows a four-start thread with a different color per thread.
The thread pitch value must permit multiple starts without causing crossing, self-intersecting threads. In the example, the pitch of the yellow thread is wide enough to allow the green, blue, and red threads to be nested inside of it.
  Trim with start face You can align threads to end faces. A Cut thread is extended and cut to match the end face. An Extrude thread is cut to match the end face.
  Trim with end face  
To use Trim with start face and Trim with end face, the profile must extend beyond the trimming face.

Before Trim

After Trim

Preview Options

  Shaded preview Displays a fully tessellated preview of the thread.
  Wireframe preview Displays a wireframe preview of the thread.
  Partial preview Adjusts the number of wires displayed in the wireframe.