Get Bodies in Components Example (VB.NET)
This example shows how to get the number of normal and user bodies in
the components in an assembly.
'-----------------------------------------------------
' Preconditions:
' 1. Verify that the specified assembly document
' to open exists.
' 2. Open the Immediate window.
'
' Postconditions:
' 1. Gets and prints each component's name, number of
' solid bodies, body names, and body types
' to the Immediate window.
' 2. Right-click filterholder<1> in the FeatureManager
' design tree and click the Open Part button.
' Notice that there are no screw holes in the part.
' 3. Close the part and examine the filterholder<1>
' component, which is the orange, flat, circular
' component located on the front of the assembly
' in the graphics area. There are screw
' holes in the component.
' 4. Examine the filterholder<1>'s information in the
' Immediate window. Because the component was
' modified in the assembly, its body is identified
' as a user body.
'
' NOTE: Because this assembly document is used by
' elsewhere, do not save changes.
'-----------------------------------------------------
Imports SolidWorks.Interop.sldworks
Imports SolidWorks.Interop.swconst
Imports System
Imports System.Diagnostics
Partial Class SolidWorksMacro
Public Sub main()
Dim swModel As ModelDoc2
Dim swAssembly As AssemblyDoc
Dim vComponents As Object
Dim oneComponent As Component2
Dim vBodies As Object
Dim vBodyInfo As Object = Nothing
Dim BodyType As Integer
Dim errors As Integer, warnings As Integer
Dim i As Integer, j As Integer
' Open the assembly
swModel = swApp.OpenDoc6("C:\Users\Public\Documents\SOLIDWORKS\SOLIDWORKS 2018\samples\tutorial\toolbox\lens_mount.sldasm", swDocumentTypes_e.swDocASSEMBLY, swOpenDocOptions_e.swOpenDocOptions_Silent, "", errors, warnings)
swAssembly = swModel
' Get the components in the assembly
vComponents = swAssembly.GetComponents(True)
For i = 0 To UBound(vComponents)
oneComponent = vComponents(i)
Debug.Print(" ")
Debug.Print("Component name: " & oneComponent.Name2)
' Get the solid bodies in the component
vBodies = oneComponent.GetBodies3(swBodyType_e.swSolidBody, vBodyInfo)
Debug.Print(" Number of solid bodies: " & (UBound(vBodies) + 1))
For j = 0 To UBound(vBodies)
Debug.Print(" Body number: " & (j + 1))
Debug.Print(" Body name: " & vBodies(j).Name)
' Print the type of body
BodyType = vBodyInfo(j)
Select Case BodyType
Case 0
Debug.Print(" Body type: user")
Case 1
Debug.Print(" Body type: normal")
End Select
Next
Next
End Sub
''' <summary>
''' The SldWorks swApp variable is pre-assigned for you.
''' </summary>
Public swApp As SldWorks
End Class