Function InsertCutSwept4( _
   ByVal Propagate As System.Boolean, _
   ByVal Alignment As System.Boolean, _
   ByVal TwistCtrlOption As System.Short, _
   ByVal KeepTangency As System.Boolean, _
   ByVal BAdvancedSmoothing As System.Boolean, _
   ByVal StartMatchingType As System.Short, _
   ByVal EndMatchingType As System.Short, _
   ByVal IsThinBody As System.Boolean, _
   ByVal Thickness1 As System.Double, _
   ByVal Thickness2 As System.Double, _
   ByVal ThinType As System.Short, _
   ByVal PathAlign As System.Short, _
   ByVal UseFeatScope As System.Boolean, _
   ByVal UseAutoSelect As System.Boolean, _
   ByVal TwistAngle As System.Double, _
   ByVal BMergeSmoothFaces As System.Boolean, _
   ByVal AssemblyFeatureScope As System.Boolean, _
   ByVal AutoSelectComponents As System.Boolean, _
   ByVal PropagateFeatureToParts As System.Boolean _
) As Feature

Dim instance As IFeatureManager
Dim Propagate As System.Boolean
Dim Alignment As System.Boolean
Dim TwistCtrlOption As System.Short
Dim KeepTangency As System.Boolean
Dim BAdvancedSmoothing As System.Boolean
Dim StartMatchingType As System.Short
Dim EndMatchingType As System.Short
Dim IsThinBody As System.Boolean
Dim Thickness1 As System.Double
Dim Thickness2 As System.Double
Dim ThinType As System.Short
Dim PathAlign As System.Short
Dim UseFeatScope As System.Boolean
Dim UseAutoSelect As System.Boolean
Dim TwistAngle As System.Double
Dim BMergeSmoothFaces As System.Boolean
Dim AssemblyFeatureScope As System.Boolean
Dim AutoSelectComponents As System.Boolean
Dim PropagateFeatureToParts As System.Boolean
Dim value As Feature
 
value = instance.InsertCutSwept4(Propagate, Alignment, TwistCtrlOption, KeepTangency, BAdvancedSmoothing, StartMatchingType, EndMatchingType, IsThinBody, Thickness1, Thickness2, ThinType, PathAlign, UseFeatScope, UseAutoSelect, TwistAngle, BMergeSmoothFaces, AssemblyFeatureScope, AutoSelectComponents, PropagateFeatureToParts)

Feature InsertCutSwept4( 
   System.bool Propagate,
   System.bool Alignment,
   System.short TwistCtrlOption,
   System.bool KeepTangency,
   System.bool BAdvancedSmoothing,
   System.short StartMatchingType,
   System.short EndMatchingType,
   System.bool IsThinBody,
   System.double Thickness1,
   System.double Thickness2,
   System.short ThinType,
   System.short PathAlign,
   System.bool UseFeatScope,
   System.bool UseAutoSelect,
   System.double TwistAngle,
   System.bool BMergeSmoothFaces,
   System.bool AssemblyFeatureScope,
   System.bool AutoSelectComponents,
   System.bool PropagateFeatureToParts
)

Feature^ InsertCutSwept4( 
&   System.bool Propagate,
&   System.bool Alignment,
&   System.short TwistCtrlOption,
&   System.bool KeepTangency,
&   System.bool BAdvancedSmoothing,
&   System.short StartMatchingType,
&   System.short EndMatchingType,
&   System.bool IsThinBody,
&   System.double Thickness1,
&   System.double Thickness2,
&   System.short ThinType,
&   System.short PathAlign,
&   System.bool UseFeatScope,
&   System.bool UseAutoSelect,
&   System.double TwistAngle,
&   System.bool BMergeSmoothFaces,
&   System.bool AssemblyFeatureScope,
&   System.bool AutoSelectComponents,
&   System.bool PropagateFeatureToParts
) 

Parameters

Propagate

True propagates the sweep cut to the next edge, false causes the sweep cut to occur only on the selected edge; to propagate to the next edge, the next edge must be tangent to the current edge

Alignment

If the curve used to sweep goes from one face to another or from one edge to another, then true causes the sweep to cut completely through the end faces of the cut, and false causes the cut to begin and end perpendicular to the sweep curve; therefore, it may not break through the two end faces of the body being cut

TwistCtrlOption

Twist control options as defined in swTwistControlType_e

KeepTangency

If the sweep section has tangent segments, true causes the corresponding surfaces in the resulting sweep to be tangent, false does not

BAdvancedSmoothing

If the sweep section has circular or elliptical arcs, true approximates the sections and smooths the surfaces, false does not

StartMatchingType

Tangency type as defined in swTangencyType_e

EndMatchingType

Tangency type as defined in swTangencyType_e

IsThinBody

True if this feature is a thin body, false if not

Thickness1

Thickness value for the first direction

Thickness2

Thickness value for the second direction

ThinType

Thin wall type as defined in swThinWallType_e

PathAlign

Align path type (see Remarks)

UseFeatScope

True if the feature only affects selected bodies, false if the feature affects all bodies

UseAutoSelect

True to automatically select all bodies and have the feature affect those bodies, false to select the bodies the feature affects (see Remarks)

TwistAngle

If TwistCtrlOption is set to swTwistControlType_e.swTwistControlConstantTwistAlongPath, then specify end twist angle

BMergeSmoothFaces

True to merge smooth faces, false to not

AssemblyFeatureScope

True if the sweep cut affects only selected components in the assembly, false if the sweep cut affects all components in the assembly (see Remarks)

AutoSelectComponents

True to auto-select all affected components in the assembly, false to use manually selected components (see Remarks)

PropagateFeatureToParts

True to extend the sweep cut feature to all affected parts in the assembly, false to just insert the sweep cut into the assembly (see Remarks)

Return Value

Before calling this method, call IModelDocExtension::SelectByID2 multiple times to select the profile, guide curves, and sweep path for the cut, setting the Mark parameter in each case as follows:

• 1 = Profile selection

• 2 = Guide-curve selection, if provided

• 4 = Sweep path selection

The PathAlign argument is available when TwistCtrlOption is set to 0 and can take one of these values:

• 0 = None; no correction (default)

• 2 = Direction vector; a plane, planar face, or line defines the path

• 3 = All faces; includes neighboring faces

When UseAutoSelect is false, the user must select the bodies that the feature will affect.

When using cut or cavity features that result in multiple bodies, you cannot select to keep all of the resulting bodies or one or more selected bodies. 

Use AssemblyFeatureScope, AutoSelectComponents, and PropagateFeatureToParts to insert sweep cuts into an assembly. AssemblyFeatureScope and AutoSelectComponents perform just like the configuration of the Feature Scope section on the PropertyManager page of the sweep feature: