Save Solid Body to File Example (C#)

//----------------------------------------------------------------------------
// Preconditions: Open public_documents\samples\tutorial\api\weldment_box3.sldprt.
//
// Postconditions:
// 1. Updates the cut list in the weldment part.
// 2. Saves the first weldment member in the FeatureManager design tree to
//    RefWeldment1.sldprt, and saves the cut list properties in the parent part
//    to the cut list of the new part.
// 3. Opens RefWeldment1.sldprt and updates its cut list. (This step could
//    take a few minutes to complete.)
// 4. At System.Diagnostics.Debugger.Break(), press F5.
// 5. Closes RefWeldment1.sldprt.
// 6. To verify steps 2 and 3, open and inspect RefWeldment1.sldprt, which resides
//    in the same folder as this macro.
//
// NOTE: Because weldment_box3.sldprt is used elsewhere, do not save changes.
//---------------------------------------------------------------------------
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System.Runtime.InteropServices;
using System;
namespace CreatePartForSolidBody_CSharp.csproj
{
    partial class SolidWorksMacro
    {

        Feature swFeat;
        BodyFolder swBodyFolder;
        bool updateBoolstatus;
        bool boolstatus;
        int longstatus;
        int longWarnings;
        ModelDoc2 currentModel;
        ModelDoc2 swModel;
        int modelType;
        string modelTitle;
        
        public void Main()
        {
            currentModel = (ModelDoc2)swApp.ActiveDoc;

            modelTitle = currentModel.GetTitle();
            modelType = currentModel.GetType();

            swFeat = (Feature)currentModel.FirstFeature();
            if (swFeat == null)
                ErrorMsg(swApp, "Failed to get first feature");

            while ((swFeat != null))
            {
                if (swFeat.GetTypeName2() == "SolidBodyFolder")
                {
                    swBodyFolder = (BodyFolder)swFeat.GetSpecificFeature2();
                    if (swBodyFolder == null)
                        ErrorMsg(swApp, "Failed to get body folder");

                    boolstatus = swBodyFolder.SetAutomaticCutList(true);

                    boolstatus = swBodyFolder.UpdateCutList();

                    break;
                }
                swFeat = (Feature)swFeat.GetNextFeature();
            }

            updateBoolstatus = false;

            swFeat = (Feature)currentModel.FirstFeature();
            if (swFeat == null)
                ErrorMsg(swApp, "Failed to get first feature");

            while ((swFeat != null))
            {
                if (swFeat.GetTypeName2() == "WeldMemberFeat")
                {
                    boolstatus = swFeat.Select2(false, 0);
                    if (boolstatus == false)
                        ErrorMsg(swApp, "Failed to select feature");

                    // Save the selected solid body weldment member to another part,
                    // transferring the solid body's cut list properties to the new part's cut list;
                    // automatically creates a weldment and cut list folder
                    boolstatus = ((PartDoc)currentModel).SaveToFile3(swApp.GetCurrentMacroPathFolder() + "\\RefWeldment1" + ".sldprt", 1, swCutListTransferOptions_e.swCutListTransferOptions_CutListProperties, false, "", out longstatus, out longWarnings);

                    System.Diagnostics.Debugger.Break();

                    if (boolstatus == false)
                        ErrorMsg(swApp, "Failed to insert weldment member into new part");

                    swModel = (ModelDoc2)swApp.ActiveDoc;
                    if (swModel == null)
                        ErrorMsg(swApp, "Failed to set open model as active document");

                    updateBoolstatus = true;
                    break;
                }
                swFeat = (Feature)swFeat.GetNextFeature();
            }

            if (updateBoolstatus == true)
            {
                swFeat = (Feature)currentModel.FirstFeature();
                if (swFeat == null)
                    ErrorMsg(swApp, "Failed to get first feature");

                while ((swFeat != null))
                {
                    if (swFeat.GetTypeName2() == "SolidBodyFolder")
                    {
                        swBodyFolder = (BodyFolder)swFeat.GetSpecificFeature2();
                        if (swBodyFolder == null)
                            ErrorMsg(swApp, "Failed to get body folder");

                        boolstatus = swBodyFolder.SetAutomaticCutList(true);
                        if (boolstatus == false)
                            ErrorMsg(swApp, "Failed to set cut list to automatic");

                        boolstatus = swBodyFolder.UpdateCutList();
                        if (boolstatus == false)
                            ErrorMsg(swApp, "Failed to update cut list");

                        swApp.CloseDoc(swModel.GetTitle());
                        break;
                    }
                    swFeat = (Feature)swFeat.GetNextFeature();
                }
            }

        }

        public void ErrorMsg(SldWorks Swapp, string Message)
        {
            Swapp.SendMsgToUser2(Message, 0, 0);
            Swapp.RecordLine("'*** WARNING - General");
            Swapp.RecordLine("'*** " + Message);
            Swapp.RecordLine("");
        }



        public SldWorks swApp;

    }

}