Modifying Section Views

To change the length or location of the section line, the length of the leader, or the position of the label:

 Select the cutting line or label and drag it.

To edit the letter label on the section line, either:
  • Double-click the letter label, edit in place, and click outside the label to exit.
  • Select the section line and edit the label and its font in the Section View PropertyManager.

To edit the note text on the section view:

 Double-click the text, edit in place, and click outside the label to exit.
To edit the properties of the section view note text, select the note and edit the properties in the Note PropertyManager. To globally change label elements, click Options (Standard toolbar), select the Document Properties tab, then select View Labels > Section .

To edit the sketch used to create the section line:

 Right-click an entity of the sketch and select Edit Sketch. Edit the sketch as needed. Then select one sketch entity and click Rebuild tool_Rebuild_Standard.gif to update the section view.

To change the cut direction as indicated by the arrows:

 Double-click anywhere along the section line, or select the section line and select Flip Direction in the Section View PropertyManager.

To modify the crosshatch pattern:

 Click a face, or hold Ctrl and select multiple faces, and make changes in the Area Hatch/Fill PropertyManager.
If a section view in a drawing needs to be updated (when a section line position or direction changes, for example), the view is marked with a crosshatch pattern.

Modifying a Section Line Before Creating the View

To modify a section line before creating the view:

  1. Double-click a drawing view and sketch a line (or multiple lines for an aligned section view) in the view.
    By double-clicking the drawing view, you ensure that the line or lines belong to the view.
  2. With the line or lines selected, click Insert > Make Section Line.
  3. Select the section line.
    The Section View PropertyManager appears.
  4. Make any changes in the PropertyManager.
  5. Do one of the following:
    • Click Section View tool_Section_View_Drawing.gif and place the view.
    • Click OK to close the PropertyManager without creating a view.
    You can select the section line and create the view at any time.

Modifying a Section Line After a Section View is Created

To modify a section line after a section view is created:

  1. Select the section line or section view.
    The Section View PropertyManager appears.
  2. Make any changes in the PropertyManager or in the graphics area and click PM_OK.gif.
    If you edit the section line in the graphics area, you may have to click Rebuild tool_Rebuild_Standard.gif (Standard toolbar) or click Edit > Rebuild to update the drawing view.

Editing Existing Section Views with Section View Assist

You can use Section View Assist to add offsets to existing section views created with Section View Assist in SOLIDWORKS 2013 and later.

Section View Assist is not available for section views whose sketches have been directly edited.

To edit existing section views with Section View Assist:

  1. Right-click on an existing section view or its cutting line and click Edit Cutting Line.
    For some complex section views created with SOLIDWORKS 2013, you must select an insertion point before you can modify them.
  2. On the Section view pop-up, click an offset.
  3. Click PM_OK.gif.