Create Bidirectional Circular Pattern Feature Example (VB.NET)

This example shows how to create a bidirectional circular pattern feature.

'-------------------------------------------------------
' Preconditions: 
' 1. Verify that the part exists.
' 2. Open the Immediate window.
'
' Postconditions:
' 1. Opens the part.
' 2. Selects a feature.
' 3. Selects an edge for Direction 1.
' 4. Creates a bidirectional circular pattern.
' 5. Examine the FeatureManager design tree,
'    graphics area, and Immediate window.
'
' NOTE: Because the part is used elsewhere, do not
' save changes.
'--------------------------------------------------------
Imports SolidWorks.Interop.sldworks
Imports SolidWorks.Interop.swconst
Imports System.Runtime.InteropServices
Imports System
Imports System.Diagnostics
 
Partial Class SolidWorksMacro
 
    Public Sub main()
 
        Dim swModel As ModelDoc2
        Dim swModelDocExt As ModelDocExtension
        Dim swFeatureManager As FeatureManager
        Dim swFeature As Feature
        Dim swCircularPatternFeatureData As CircularPatternFeatureData
        Dim status As Boolean
        Dim errors As Integer
        Dim warnings As Integer
        Dim fileName As String
 
        fileName = "C:\Users\Public\Documents\SOLIDWORKS\SOLIDWORKS 2019\samples\tutorial\api\featurecircularpattern.sldprt"
        swModel = swApp.OpenDoc6(fileName, swDocumentTypes_e.swDocPART, swOpenDocOptions_e.swOpenDocOptions_Silent, "", errors, warnings)
        swModelDocExt = swModel.Extension
        swFeatureManager = swModel.FeatureManager
        status = swModelDocExt.SelectByID2("Boss-Extrude2", "BODYFEATURE", -0.0000568552547690615, 0.0336059294503599, 0.0699999999999932, False, 4, Nothing, 0)
        status = swModelDocExt.SelectByRay(0.0289184346104037, 0.0205122863998071, 0.0598787397922251, 0.342497149434059, -0.159204982974168, -0.925931679998983, 0.000912809005339891, 1, True, 1, 0)
        swCircularPatternFeatureData = swFeatureManager.CreateDefinition(swFeatureNameID_e.swFmCirPattern)
    swFeature = swFeatureManager.CreateFeature(swCircularPatternFeatureData)
 
        swCircularPatternFeatureData = swFeature.GetDefinition
        Debug.Print("Direction 1:")
        Debug.Print("  Equal spacing: " & swCircularPatternFeatureData.EqualSpacing)
        Debug.Print("  Spacing: " & swCircularPatternFeatureData.Spacing)
        Debug.Print("  Total instances: " & swCircularPatternFeatureData.TotalInstances)
        If swCircularPatternFeatureData.Direction2 Then
            Debug.Print("Direction 2:")
            Debug.Print("  Symmetric: " & swCircularPatternFeatureData.Symmetric)
            Debug.Print("  Equal spacing: " & swCircularPatternFeatureData.EqualSpacing2)
            Debug.Print("  Spacing: " & swCircularPatternFeatureData.Spacing2)
            Debug.Print("  Total instances: " & swCircularPatternFeatureData.TotalInstances2)
        End If
 
    End Sub
 
    ''' <summary>
    ''' The SldWorks swApp variable is pre-assigned for you.
    ''' </summary>
    Public swApp As SldWorks
 
 
End Class