Function SetDisplayMode4( _
   ByVal UseParent As System.Boolean, _
   ByVal Mode As System.Integer, _
   ByVal Faceted As System.Boolean, _
   ByVal Edges As System.Boolean, _
   ByVal CThreadHighQuality As System.Boolean _
) As System.Boolean

Dim instance As IView
Dim UseParent As System.Boolean
Dim Mode As System.Integer
Dim Faceted As System.Boolean
Dim Edges As System.Boolean
Dim CThreadHighQuality As System.Boolean
Dim value As System.Boolean
 
value = instance.SetDisplayMode4(UseParent, Mode, Faceted, Edges, CThreadHighQuality)

System.bool SetDisplayMode4( 
   System.bool UseParent,
   System.int Mode,
   System.bool Faceted,
   System.bool Edges,
   System.bool CThreadHighQuality
)

System.bool SetDisplayMode4( 
&   System.bool UseParent,
&   System.int Mode,
&   System.bool Faceted,
&   System.bool Edges,
&   System.bool CThreadHighQuality
) 

Parameters

UseParent

True to use the parent's settings, false to use this drawing view's local settings (see Remarks)

Mode

Display mode of the drawing view as defined in swDisplayMode_e (see Remarks)

Faceted

True for draft quality, false for precision quality (see Remarks)

Edges

True if edges are displayed when this view is in shaded mode, false if not

CThreadHighQuality

True for precision quality cosmetic threads, false for draft quality

Return Value

'VBA

'-------------------------------------
' Preconditions:
' 1. Open a drawing and select a drawing view.
' 2. Open the Immediate window.
'
' Postconditions:
' 1. Gets the selected view's current display mode properties.
' 2. Resets the display mode properties.
' 3. Gets the new display mode properties.
' 4. Examine the Immediate window.
'--------------------------------------

Option Explicit
Sub main()

    Dim swApp As SldWorks.SldWorks
    Dim swModel As SldWorks.ModelDoc2
    Dim swDraw As SldWorks.DrawingDoc
    Dim swSheet As SldWorks.Sheet
    Dim swView As SldWorks.View
    Dim bRet As Boolean
    Dim swSelectionMgr As SldWorks.SelectionMgr

    Set swApp = SolidWorks.SldWorks
    Set swModel = swApp.ActiveDoc
    Set swDraw = swModel
    Set swSheet = swDraw.GetCurrentSheet
    Set swSelectionMgr = swModel.SelectionManager
   
    Set swView = swSelectionMgr.GetSelectedObject6(1, -1)

    Debug.Print "=====Current Display Mode======"
    Debug.Print ""

    Dim UseParentProp As Boolean
    UseParentProp = swView.GetUseParentDisplayMode
    Debug.Print "Using parent view's display mode?  " & UseParentProp
   
    Dim displayMode As Long
    displayMode = swView.GetDisplayMode2
    Debug.Print "Current display mode as defined by swDisplayMode_e:  " & displayMode
   
    Dim Faceted As Boolean
    Faceted = swView.GetFacettedHlrDisplay
    Debug.Print "Display faceted?:  " & Faceted
   
    Dim EdgesMode As Boolean
    EdgesMode = swView.GetDisplayEdgesInShadedMode
    Debug.Print "Display edges when the view is in shaded mode?  " & EdgesMode
   
   
    Dim cThreadQuality As Boolean
    cThreadQuality = swView.GetCThreadQuality
    Debug.Print "Precision quality for cosmetic threads? " & swView.GetCThreadQuality
   
    swView.SetDisplayMode4 False, 3, True, False, True
   
    Debug.Print "=====After Re-setting Display Mode======"
    Debug.Print ""
    Debug.Print "Using parent view's display mode?  " & swView.GetUseParentDisplayMode
    Debug.Print "Current display mode as defined by swDisplayMode_e:  " & swView.GetDisplayMode2
    Debug.Print "Display faceted?  " & swView.GetFacettedHlrDisplay
    Debug.Print "Display edges when the view is in shaded mode?  " & swView.GetDisplayEdgesInShadedMode
    Debug.Print "Precision quality for cosmetic threads? " & swView.GetCThreadQuality

End Sub

If UseParent is true and a parent view:

• Exists, then this method's Mode, Faceted, and Edges parameters are ignored.
• Does not exist, then this method does not change the current display mode of this drawing view.

Mode specifies the drawing view display as defined by swDisplayMode_e.:

• swWIREFRAME
• swHIDDEN (Hidden Lines Removed)
• swHIDDEN_GREYED (Hidden Lines Visible)
• swSHADED
• swSHADED_EDGES

swDisplayMode_e also contains three other values that seem to indicate faceted (draft) geometry:

• swFACETED_WIREFRAME
• swFACETED_HIDDEN_GREYED
• swFACETED_HIDDEN

However in this method, you must use the Faceted parameter (not the Mode parameter) to specify draft or precision quality. If you specify Mode with swFACETED_WIREFRAME, swFACETED_HIDDEN_GREYED, or swFACETED_HIDDEN, then SOLIDWORKS instead uses swWIREFRAME, swHIDDEN_GREYED, or swHIDDEN.

NOTE: Just as displaying geometry precisely can decrease performance, setting the Faceted argument to true (draft quality) can increase performance.