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Change Bend Radius of Sheet Metal Part Example (VBA)

This example shows how to change the default bend radius of a sheet metal part.

' Preconditions:
' 1. Open a sheet metal part.
' 2. Select the Sheet-Metal feature.
' 3. Open the Immediate window.
' Postconditions:
' 1. Doubles the default bend radius .
' 2. Examine the graphics area and Immediate window.
Option Explicit
Sub main()
    Dim swApp As SldWorks.SldWorks
    Dim swModel As SldWorks.ModelDoc2
    Dim swSelMgr As SldWorks.SelectionMgr
    Dim swFeat As SldWorks.Feature
    Dim swSheetMetal As SldWorks.SheetMetalFeatureData
    Dim bRet As Boolean
    Set swApp = Application.SldWorks
    Set swModel = swApp.ActiveDoc
    Set swSelMgr = swModel.SelectionManager
    Set swFeat = swSelMgr.GetSelectedObject5(1)
    Set swSheetMetal = swFeat.GetDefinition
    Debug.Print "Feature = " & swFeat.Name
    Debug.Print "  Original bend radius = " & swSheetMetal.BendRadius * 1000# & " mm"
    ' Rollback to change default bend radius
    bRet = swSheetMetal.AccessSelections(swModel, Nothing): Debug.Assert bRet
    ' Double the default bend radius value
    swSheetMetal.BendRadius = 2# * swSheetMetal.BendRadius
    ' Apply changes
    bRet = swFeat.ModifyDefinition(swSheetMetal, swModel, Nothing): Debug.Assert bRet
    Debug.Print "  Modified bend radius = " & swSheetMetal.BendRadius * 1000# & " mm"
End Sub

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