// ====================================================================================

// Preconditions:

// 1. Ensure that the paths to templates and gauge tables are valid.

// 2. Open an Immediate window.

// 3. Press F5 repeatedly and inspect the Immediate window and FeatureManager design tree as instructed.

//

// Postconditions:

// 1. Creates Sketch1 for the sweep path.

// 2. Creates Sketch2 for the sweep profile.

// 3. Creates Swept Flange1 using a gauge table installed with SOLIDWORKS.

// 4. Displays gauge table parameters.

// 5. Modifies Swept Flange1 to override the gauge number, bend radius, and gauge thickness.

// 6. Displays new gauge parameters.

// ============================================

using System;

using System.Collections.Generic;

using System.Diagnostics;

using System.Globalization;

using System.IO;

using System.Linq;

using System.Reflection;

using System.Runtime.CompilerServices;

using System.Security;

using System.Text;

using System.Threading.Tasks;

using Microsoft.VisualBasic;

using SolidWorks.Interop.sldworks;

using SolidWorks.Interop.swconst;

using System.Runtime.InteropServices;

 

 

namespace CreateSweptFlangeUsingGaugeTable_CSharp

{

    public partial class SolidWorksMacro

    {

        public void Main()

        {

          

                PartDoc swPart;

                ModelDoc2 swModel;

                Feature swFeat;

                FeatureManager swFeatMgr;

                SweptFlangeFeatureData swSweptFlangeFeatureData;

                SweptFlangeFeatureData featData;

                SheetMetalGaugeTableParameters smGaugeTableParam;

                SketchSegment skSegment;

                RefPlane myRefPlane;

                int swFeatNameID;

                Feature[] swSketch = new Feature[1];

                bool boolstatus;

                int errCode;

                double swSheetWidth;

                double swSheetHeight;

                string gaugePath = null;

                int gaugeCount;

                string[] gaugeNumbers;

                int i;

                int radiiCount;

                double[] radii;

                string newgaugePath = null;

 

                swSheetWidth = 0;

                swSheetHeight = 0;

                swModel = (ModelDoc2)swApp.NewDocument(@"E:\Program Files\SOLIDWORKS Corp\SOLIDWORKS\lang\english\Tutorial\part.prtdot", 0, swSheetWidth, swSheetHeight);

 

                swPart = (PartDoc)swModel;

                swModel = (ModelDoc2)swApp.ActiveDoc;

 

                skSegment = swModel.SketchManager.Create3PointArc(-0.058601, -0.015313, 0.0, -0.003828, -0.021603, 0.0, 0.002265, -0.05642, 0.0);

                swModel.ClearSelection2(true);

                swModel.SketchManager.InsertSketch(true); // Sketch1

                swModel.ClearSelection2(true);

 

                boolstatus = swModel.Extension.SelectByID2("Point2@Sketch1", "EXTSKETCHPOINT", -0.003828, -0.021603, 0, true, 0, null, 0);

                boolstatus = swModel.Extension.SelectByID2("Arc1@Sketch1", "EXTSKETCHSEGMENT", 0.00285760095397308, -0.0342380271903227, 0, true, 1, null, 0);

 

                myRefPlane = (RefPlane)swModel.FeatureManager.InsertRefPlane(4, 0, 2, 0, 0, 0);

 

                boolstatus = swModel.Extension.SelectByID2("Plane1", "PLANE", 0.0103901931573406, -0.00917038599747196, -0.00622490227027586, true, 0, null, 0);

 

                swModel.SketchManager.InsertSketch(true);

                skSegment = swModel.SketchManager.CreateLine(0.0, 0.0, 0.0, 0.0, 0.018316, 0.0);

                skSegment = swModel.SketchManager.CreateLine(0.0, 0.018316, 0.0, 0.008362, 0.035435, 0.0);

                swModel.ClearSelection2(true);

                swModel.SketchManager.InsertSketch(true); // Sketch2

 

                swFeatNameID = (int)swFeatureNameID_e.swFmSweptFlange;

                swFeatMgr = swModel.FeatureManager;

                swSweptFlangeFeatureData = (SweptFlangeFeatureData)swFeatMgr.CreateDefinition(swFeatNameID);

 

                swModel.ClearSelection2(true);

 

                // Select the sweep path

                boolstatus = swModel.Extension.SelectByID2("Sketch1", "SKETCH", 0, 0, 0, false, 0, null, 0);

                swSketch[0] = (Feature)((SelectionMgr)(swModel.SelectionManager)).GetSelectedObject6(1, -1);

 

                swSweptFlangeFeatureData.Path = swSketch;

 

                // Select the sweep profile

                boolstatus = swModel.Extension.SelectByID2("Sketch2", "SKETCH", 0, 0, 0, false, 0, null, 0);

                swSweptFlangeFeatureData.Profile = (Feature)((SelectionMgr)(swModel.SelectionManager)).GetSelectedObject6(1, -1);

 

                errCode = swSweptFlangeFeatureData.GetErrorCodes();

                Debug.Print("Swept flange definition error code: " + System.Convert.ToString(errCode));

 

                System.Diagnostics.Debugger.Break(); // Inspect the Immediate window for the swept flange definition error

 

                swSweptFlangeFeatureData.UseMaterialSheetMetalParameters = false;

                swSweptFlangeFeatureData.UseGaugeTable = true;

 

                Debug.Print("Use gauge table? " + System.Convert.ToString(swSweptFlangeFeatureData.UseGaugeTable));

 

                smGaugeTableParam = (SheetMetalGaugeTableParameters)swSweptFlangeFeatureData.GetGaugeTableParameters();

                boolstatus = smGaugeTableParam.GetGaugeTablePath(gaugePath);

 

                if (boolstatus == false)

                    smGaugeTableParam.SetGaugeTablePath(@"E:\Program Files\SOLIDWORKS Corp\SOLIDWORKS\LANG\ENGLISH\SHEET METAL GAUGE TABLES\BEND ALLOWANCE MM SAMPLE.XLS");

 

                boolstatus = smGaugeTableParam.GetGaugeTablePath(gaugePath);

                Debug.Print("Got gauge table path? " + System.Convert.ToString(boolstatus));

                Debug.Print("Gauge table path: " + gaugePath);

                Debug.Print("Process: " + smGaugeTableParam.Process);

 

                gaugeCount = smGaugeTableParam.GetGaugeNumberCount();

                Debug.Print("Gauge number count: " + System.Convert.ToString(gaugeCount));

 

                Debug.Print("Available gauge numbers: ");

 

                gaugeNumbers = (string[])smGaugeTableParam.GetAvailableGaugeNumbers();

 

                for (i = 0; i <= gaugeCount - 1; i++)

                    Debug.Print(gaugeNumbers[i]);

                Debug.Print("Current gauge number: " + smGaugeTableParam.GetCurrentGaugeNumber());

 

                System.Diagnostics.Debugger.Break(); // Inspect the Immediate window for the current gauge number

 

                radiiCount = smGaugeTableParam.GetRadiiCount();

                Debug.Print("Bend radii count: " + System.Convert.ToString(smGaugeTableParam.GetRadiiCount()));

 

                Debug.Print("Available bend radii: ");

                radii = (double[])smGaugeTableParam.GetAvailableRadii();

                for (i = 0; i <= radiiCount - 1; i++)

                    Debug.Print(radii[i].ToString());

                Debug.Print("Current bend radius: " + System.Convert.ToString(smGaugeTableParam.GetCurrentRadius()));

                Debug.Print("Thickness: " + System.Convert.ToString(smGaugeTableParam.GetThickness()));

                Debug.Print("Override thickness? " + System.Convert.ToString(smGaugeTableParam.OverrideThickness));

                Debug.Print("Override bend radius? " + System.Convert.ToString(smGaugeTableParam.OverrideRadius));

                Debug.Print("Reverse direction? " + System.Convert.ToString(smGaugeTableParam.ReverseDirection));

 

                System.Diagnostics.Debugger.Break(); // Inspect the Immediate window for current bend radius and current gauge thickness

 

                swSweptFlangeFeatureData.SetGaugeTableParameters(smGaugeTableParam);

 

                swFeat = swFeatMgr.CreateFeature(swSweptFlangeFeatureData);

 

                errCode = swSweptFlangeFeatureData.GetErrorCodes();

                Debug.Print("Swept flange creation error code: " + System.Convert.ToString(errCode));

                swModel.ClearSelection2(true);

 

                System.Diagnostics.Debugger.Break(); // Inspect the Immediate window for the swept flange creation status

                                                     // Observe Sheet-Metal, Swept Flange1, and Flat-Pattern in the FeatureManager design tree

 

                // Set new gauge number and override gauge thickness and bend radius

                featData = (SweptFlangeFeatureData)swFeat.GetDefinition();

                smGaugeTableParam = (SheetMetalGaugeTableParameters)featData.GetGaugeTableParameters();

 

                smGaugeTableParam.ReverseDirection = true;

                smGaugeTableParam.SetCurrentGaugeNumber("Gauge 3");

                smGaugeTableParam.SetThickness(0.006, true);

                smGaugeTableParam.SetRadius(0.006, true);

 

                featData.SetGaugeTableParameters(smGaugeTableParam);

                boolstatus = swFeat.ModifyDefinition(featData, swModel, null)

                Debug.Print("Swept flange modification status: " + System.Convert.ToString(boolstatus));

 

                System.Diagnostics.Debugger.Break(); // Inspect the Immediate window for the swept flange modification status

 

                // Get new gauge number

                boolstatus = featData.AccessSelections(swModel, null);

                smGaugeTableParam = (SheetMetalGaugeTableParameters)featData.GetGaugeTableParameters();

 

                boolstatus = smGaugeTableParam.GetGaugeTablePath(newgaugePath);

                Debug.Print("Got gauge table path? " + System.Convert.ToString(boolstatus));

                Debug.Print("Gauge table path: " + newgaugePath);

 

                Debug.Print("Process: " + smGaugeTableParam.Process);

 

                gaugeCount = smGaugeTableParam.GetGaugeNumberCount();

                Debug.Print("Gauge number count: " + System.Convert.ToString(gaugeCount));

                Debug.Print("Available gauge numbers: ");

                gaugeNumbers = (string[])smGaugeTableParam.GetAvailableGaugeNumbers();

 

                for (i = 0; i <= gaugeCount - 1; i++)

                    Debug.Print(gaugeNumbers[i]);

                Debug.Print("Current gauge number: " + smGaugeTableParam.GetCurrentGaugeNumber());

 

                System.Diagnostics.Debugger.Break(); // Inspect the Immediate window for the new gauge number

 

                // Get new bend radius and gauge thickness

                radiiCount = smGaugeTableParam.GetRadiiCount();

                Debug.Print("Bend radii count: " + System.Convert.ToString(radiiCount));

 

                Debug.Print("Available bend radii: ");

                radii = (double[])smGaugeTableParam.GetAvailableRadii();

                for (i = 0; i <= radiiCount - 1; i++)

                    Debug.Print(radii[i].ToString());

                Debug.Print("Current bend radius: " + System.Convert.ToString(smGaugeTableParam.GetCurrentRadius()));

 

                Debug.Print("Thickness: " + System.Convert.ToString(smGaugeTableParam.GetThickness()));

                Debug.Print("Override thickness? " + System.Convert.ToString(smGaugeTableParam.OverrideThickness));

                Debug.Print("Override bend radius? " + System.Convert.ToString(smGaugeTableParam.OverrideRadius));

                Debug.Print("Reverse direction? " + System.Convert.ToString(smGaugeTableParam.ReverseDirection));

 

                featData.ReleaseSelectionAccess();

 

                System.Diagnostics.Debugger.Break(); // Inspect the Immediate window for the new bend radius and gauge thickness

            }

         

 

    // The SldWorks swApp variable is pre-assigned for you.

    public SldWorks swApp;

 

    }

}