SOLIDWORKS API Help

Create Rack and Pinion Mate Example (C#)

This example shows how to create a rack and pinion mechanical mate.

// ------------------------------------------------------------------------------
// Preconditions:
// 1. Open public_documents\samples\tutorial\api\MechanicalMates\Rack And Pinion.sldasm.
// 2. Delete RackPinionMate1 from the Mates folder of the FeatureManager design tree.
//
// Postconditions: Inspect the Mates folder in the FeatureManager design tree.
//
// NOTE: Because the model is used elsewhere, do not save changes. 
// ------------------------------------------------------------------------------
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System.Runtime.InteropServices;
using System;
 
namespace CreateRackPinionMate_CSharp
{
    partial class SolidWorksMacro
    {
 
        private ModelDoc2 Part;
        private AssemblyDoc swAssembly;
        private bool boolstatus;
 
 
        public void Main()
        {
 
            Part = (ModelDoc2)swApp.ActiveDoc;
            swAssembly = (AssemblyDoc)Part;
 
            boolstatus = Part.Extension.SelectByRay(-0.0463518983485187, 0.061012999696942, -0.00642963015610576, -0.398796540128449, 0.236369842894561, -0.886053393962, 0.000798486578462134, 1, true, 64, 0);
            boolstatus = Part.Extension.SelectByRay(0.00790589165686129, -0.00993915877270979, -0.00438167267822109, -0.398796540128449, 0.236369842894561, -0.886053393962, 0.000798486578462134, 2, true, 128, 0);
 
            // Create RackPinionMateFeatureData
            RackPinionMateFeatureData MateData = (RackPinionMateFeatureData)swAssembly.CreateMateData(13);
 
            // Set the mate diameter type
            MateData.DiameterType = 0;
 
            // Set the mate diameter value
            MateData.DiameterVal = 0.0254;
 
            // Set the mate orientation direction
            MateData.Reverse = false;
 
            // Create the mate
            Feature MateFeature = (Feature)swAssembly.CreateMate(MateData);
            Part.ClearSelection2(true);
            Part.EditRebuild3();
 
        }
 
        /// <summary>
        /// The SldWorks swApp variable is pre-assigned for you.
        /// </summary>
        public SldWorks swApp;
    }
 
 
}