//========================================================================

// Preconditions: Ensure that the specified part template exists.

//

// Postconditions:

// 1. Base-Flange1 and Swept Flange1 are created.

// 2. Inspect the graphics area and the FeatureManager design tree.

// ================================================

using SolidWorks.Interop.sldworks;

using SolidWorks.Interop.swconst;

 

namespace CreateSweptFlange_CSharp

{

    public partial class SolidWorksMacro

    {

        public void Main()

        {

                Feature swFeat;

                Feature myFeature;

                FeatureManager swFeatMgr;

                SweptFlangeFeatureData swFeatData;

                CustomBendAllowance customBendAllowanceData;

                Feature swProfileSketch;

                SketchSegment skSegment;

                ModelDoc2 Part;

                PartDoc swPart;

                bool boolstatus;

                double swSheetWidth;

                swSheetWidth = 0;

                double swSheetHeight;

                swSheetHeight = 0;

                Part = (ModelDoc2)swApp.NewDocument(@"E:\Program Files\SOLIDWORKS Corp\SOLIDWORKS\lang\english\Tutorial\part.prtdot", 0, swSheetWidth, swSheetHeight);

 

                swPart = (PartDoc)Part;

                Part = (ModelDoc2)swApp.ActiveDoc;

 

                Part.SketchManager.InsertSketch(true);

                boolstatus = Part.Extension.SelectByID2("Front", "PLANE", -0.0350345417518034, 0.019677523162802, 0.00511863136830445, false, 0, null, 0);

                Part.ClearSelection2(true);

                boolstatus = Part.Extension.SetUserPreferenceToggle((int)swUserPreferenceToggle_e.swSketchAddConstToRectEntity, (int)swUserPreferenceOption_e.swDetailingNoOptionSpecified, false);

                boolstatus = Part.Extension.SetUserPreferenceToggle((int)swUserPreferenceToggle_e.swSketchAddConstLineDiagonalType, (int)swUserPreferenceOption_e.swDetailingNoOptionSpecified, true);

                object vSkLines;

                vSkLines = Part.SketchManager.CreateCornerRectangle(-0.0420403557341645, 0.0275066828701494, 0, 0.0475026757367474, -0.0220443628675665, 0);

                Part.ClearSelection2(true);

 

                Part.ShowNamedView2("*Trimetric", 8);

                Part.ViewZoomtofit2();

 

                customBendAllowanceData = Part.FeatureManager.CreateCustomBendAllowance();

                customBendAllowanceData.KFactor = 0.5;

 

                myFeature = Part.FeatureManager.InsertSheetMetalBaseFlange2(0.0007366, false, 0.0007366, 0.02, 0.01, false, 0, 0, 1, customBendAllowanceData, false, 0, 0.0001, 0.0001, 0.5, true, false, true, true);

 

                Part.ClearSelection2(true);

                Part.SketchManager.InsertSketch(true);

                boolstatus = Part.Extension.SelectByID2("", "FACE", 0.0441584745988735, 0.0275066828701256, -0.000252375262334681, true, 0, null, 0);

 

                skSegment = Part.SketchManager.CreateLine(0.047503, 0.0, 0.0, 0.047503, -0.015713, 0.0);

                Part.ClearSelection2(true);

                Part.SketchManager.InsertSketch(true);

 

                boolstatus = Part.Extension.SelectByID2("Sketch6", "SKETCH", 0.0254585357375204, -0.00378791126417555, -0.013876316631307, true, 0, null, 0);

                boolstatus = Part.Extension.SelectByRay(0.0472949686339916, 0.0133307046879168, 0.000207707102561017, -0.499999999999997, -0.707106781186554, -0.499999999999995, 0.000423592175091009, 1, true, 0, 0);

                Part.ClearSelection2(true);

 

                // Select the sketch for the profile

                boolstatus = Part.Extension.SelectByID2("Sketch6", "SKETCH", 0.0254585357375204, -0.00378791126417555, -0.013876316631307, true, 0, null, 0);

                swProfileSketch = (Feature)((SelectionMgr)Part.SelectionManager).GetSelectedObject6(1, -1);

                Part.ClearSelection2(true);

 

                // Select an edge for the path

                Edge[] swPathObj = new Edge[1];

                boolstatus = Part.Extension.SelectByRay(0.0472949686339916, 0.0133307046879168, 0.000207707102561017, -0.499999999999997, -0.707106781186554, -0.499999999999995, 0.000423592175091009, 1, true, 0, 0);

                swPathObj[0] = (Edge)((SelectionMgr)Part.SelectionManager).GetSelectedObject6(1, -1);

 

            Part.ClearSelection2(true);

 

                swFeatMgr = Part.FeatureManager;

 

                swFeatData = (SweptFlangeFeatureData)swFeatMgr.CreateDefinition((int)swFeatureNameID_e.swFmSweptFlange);

                swFeatData.EndOffset = 0;

                swFeatData.FlangePosition = (int)swSweptFlangePositionTypes_e.swSweptFlangePositionType_MaterialInside;

                swFeatData.FlattenAlongPath = false;

                swFeatData.OverrideDefaultSheetMetalParameters = false;

                swFeatData.Path = swPathObj;

                swFeatData.Profile = swProfileSketch;

                swFeatData.ReverseDirection = false;

                swFeatData.StartOffset = 0;

                swFeatData.TrimSideBends = false;

                swFeatData.UseDefaultBendAllowance = true;

                swFeatData.UseDefaultBendRelief = true;

                swFeatData.UseDefaultRadius = false;

                swFeatData.UseGaugeTable = false;

                swFeatData.UseMaterialSheetMetalParameters = false;

                swFeat = swFeatMgr.CreateFeature(swFeatData);

                Part.ClearSelection2(true);

            }

 

    // The SldWorks swApp variable is pre-assigned for you.

    public SldWorks swApp;

 

    }

}