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Create Base Flange Feature Example (C#)

This example shows how to create a base flange feature.

// ===========================================================

// Preconditions:

// 1. Ensure the specified part template exists.

// 2. Open the Immediate window.

//

// Postconditions:

// 1. Creates a flange profile sketch.

// 2. Creates Base-Flange1 in the FeatureManager design tree.

// 3. Inspect the Immediate window, graphics area,

// and FeatureManager design tree.

// ==================================================

 

using SolidWorks.Interop.sldworks;

using SolidWorks.Interop.swconst;

using System.Diagnostics;

 

 

namespace Macro1_CSharp

{

    public partial class SolidWorksMacro

    {

        private ModelDoc2 Part;

        private PartDoc swPart;

        private ModelDoc2 swModel;

        private Feature swSKFeat;

        private SketchSegment skSegment;

        private BaseFlangeFeatureData swBaseFlangeFeat;

        private BaseFlangeFeatureData baseFlangeFeatData;

        private CustomBendAllowance cba;

        private object[] var;

        private Feature parent;

        private Feature SHFeat;

        private SheetMetalFeatureData smFeatData;

        private CustomBendAllowance cba1;

        private bool boolstatus;

 

 

        public void Main()

        {

            Part = (ModelDoc2)swApp.ActiveDoc;

            double swSheetWidth;

            swSheetWidth = 0d;

            double swSheetHeight;

            swSheetHeight = 0d;

            Part = (ModelDoc2)swApp.NewDocument(@"C:\ProgramData\SolidWorks\SOLIDWORKS 2022\templates\Part.prtdot", 0, swSheetWidth, swSheetHeight);

            swPart = (PartDoc)Part;

            swModel = (ModelDoc2)swApp.ActiveDoc;

            boolstatus = Part.Extension.SelectByID2("Top", "PLANE", -0.0598881514598713d, 0.0393749830258702d, 0.00485137895479469d, false, 0, null, 0);

            Part.SketchManager.InsertSketch(true);

            Part.ClearSelection2(true);

            skSegment = Part.SketchManager.CreateLine(-0.140779d, 0.050824d, 0d, -0.106481d, -0.06735d, 0d);

            skSegment = Part.SketchManager.CreateLine(-0.106481d, -0.06735d, 0d, 0.084966d, -0.049265d, 0d);

            skSegment = Part.SketchManager.CreateLine(0.084966d, -0.049265d, 0d, 0.143274d, 0.063608d, 0d);

            Part.ClearSelection2(true);

            Part.SketchManager.InsertSketch(true);

            swSKFeat = (Feature)((SelectionMgr)(swModel.SelectionManager)).GetSelectedObject6(1, -1);

            Debug.Print("Flange profile name : " + swSKFeat.Name + " and type : " + swSKFeat.GetTypeName2());

            swBaseFlangeFeat = (BaseFlangeFeatureData)swModel.FeatureManager.CreateDefinition((int)swFeatureNameID_e.swFmBaseFlange);

            cba = (CustomBendAllowance)swBaseFlangeFeat.GetCustomBendAllowance();

            cba.Type = (int)swBendAllowanceTypes_e.swBendAllowanceDirect;

            cba.BendAllowance = 0.05d;

            swBaseFlangeFeat.D1EndConditionType = 1;

            swBaseFlangeFeat.D1EndConditionDistance = 0.02d;

            swBaseFlangeFeat.ReverseDirection = true;

            swBaseFlangeFeat.OffsetDirections = 2;

            swBaseFlangeFeat.D2EndConditionType = 1;

            swBaseFlangeFeat.D2EndConditionDistance = 0.05d;

            swBaseFlangeFeat.OverrideDefaultSheetMetalParameters = true;

            swBaseFlangeFeat.Thickness = 0.035d;

 

            // Initialize the base flange feature

            // Initialize(

            // UseMaterialSheetMetalParameters=False,

            // UseDefaultBendAllowance=False,

            // CustomBendAllowance,

            // UseDefaultBendRelief=False,

            // ReliefType=swSheetMetalReliefTypes_e.swSheetMetalReliefRectangular,

            // UseReliefRatio=True,

            // ReliefRatio=0.8m,

            // ReliefWidth,

            // ReliefDepth)

 

            swBaseFlangeFeat.Initialize(false, false, cba, false, (int)swSheetMetalReliefTypes_e.swSheetMetalReliefRectangular, true, 0.8d, 0d, 0d);

            SHFeat = swModel.FeatureManager.CreateFeature(swBaseFlangeFeat);

            baseFlangeFeatData = (BaseFlangeFeatureData)SHFeat.GetDefinition();

            Debug.Print("Use material sheet metal parameters? " + baseFlangeFeatData.UseMaterialSheetMetalParameters);

            Debug.Print("Use default bend allowance? " + baseFlangeFeatData.UseDefaultBendAllowance);

            Debug.Print("Use default bend relief? " + baseFlangeFeatData.UseDefaultBendRelief);

            Debug.Print("Use relief ratio? " + baseFlangeFeatData.UseReliefRatio);

            Debug.Print("Relief type as defined by swSheetMetalReliefTypes_e: " + baseFlangeFeatData.ReliefType);

            Debug.Print("Relief width: " + baseFlangeFeatData.ReliefWidth);

            Debug.Print("Relief depth: " + baseFlangeFeatData.ReliefDepth);

            Debug.Print("Relief ratio: " + baseFlangeFeatData.ReliefRatio);

 

            // Modify the relief ratio and override default AutoRelief in the parent sheet metal feature

            var = (object[])SHFeat.GetParents();

            parent = (Feature)var[1];

            Debug.Print("Parent type: " + parent.GetTypeName2());

            smFeatData = (SheetMetalFeatureData)parent.GetDefinition();

            cba1 = smFeatData.GetCustomBendAllowance();

            Debug.Print("Custom bend allowance type as defined in swBendAllowanceTypes_e: " + cba1.Type);

            Debug.Print("Bend allowance: " + cba1.BendAllowance);

            Debug.Print("Result code for override of AutoRelief as defined by swSheetMetalModifierError_e: " + smFeatData.SetOverrideDefaultParameter2((int)swSheetMetalOverrideDefaultParameters_e.swSheetMetalOverrideDefaultParameters_AutoRelief, true));

            smFeatData.ReliefRatio = 0.7d;

            Debug.Print("Base flange successfully modified? " + parent.ModifyDefinition(smFeatData, swModel, null));

            Debug.Print("Base flange feature name : " + SHFeat.Name + " and type : " + SHFeat.GetTypeName2());

        }

 

        // The SldWorks swApp variable is pre-assigned for you.

        public SldWorks swApp;

 

    }

}