Hide Table of Contents

Create Fill Pattern Example (C#)

This example shows how to create a Fill Pattern feature and get its data.

//--------------------------------------------------------------------------
// Preconditions: Ensure the specified part exists.
//
// Postconditions:
// 1. Extrudes a hole in the middle of the block.
// 2. Creates a circular fill pattern of the specified hole.
// 3. Inspect the graphics area and the FeatureManager design tree.
//
// NOTE: Because the model is used elsewhere, do not save changes.
//--------------------------------------------------------------------------
using SolidWorks.Interop.sldworks;
using SolidWorks.Interop.swconst;
using System.Runtime.InteropServices;
using System;
 
namespace CreateFillPattern_CSharp
{
    partial class SolidWorksMacro
    {
 
        private Feature myFeature;
        private Feature swFeat;
        private FeatureManager swFeatMgr;
        private ModelDoc2 Part;
        private FillPatternFeatureData swFeatData;
        private bool boolstatus;
        
 
        public void Main()
        {
 
            int longstatus = 0;
            int longwarnings = 0;
            Part = swApp.OpenDoc6("C:\\Users\\Public\\Documents\\SOLIDWORKS\\SOLIDWORKS 2019\\samples\\tutorial\\api\\block20.sldprt", 1, 0, "", longstatus, longwarnings);
            swApp.ActivateDoc2("block20.sldprt"false, longstatus);
            Part = (ModelDoc2)swApp.ActiveDoc;
 
            boolstatus = Part.Extension.SelectByID2("""", -0.0032, 0.0418, 0.0, false, 0, null, 0);
            myFeature = Part.FeatureManager.SimpleHole2(0.0054, truefalsefalse, 1, 0, 0.0254, 0.0254, falsefalsefalsefalse, 0.0174532925199433, 0.0174532925199433, falsefalsefalsefalsetruetruetruetruefalse);
            ((SelectionMgr)(Part.SelectionManager)).EnableContourSelection = false;
            Part.ActivateSelectedFeature();
 
            boolstatus = Part.Extension.SelectByID2("Hole1""BODYFEATURE", 0, 0, 0, false, 4, null, 0);
            boolstatus = Part.Extension.SelectByRay(0.00106119575008097, 0.039624, 0.0493456023787655, -0.400036026779312, -0.515038074910024, -0.758094294050284, 0.0011224765174324, 1, true, 1, 0);
            boolstatus = Part.Extension.SelectByRay(0.0636836165047043, 0.0396239999998329, -0.000633171793538168, -0.400036026779312, -0.515038074910024, -0.758094294050284, 0.0011224765174324, 2, true, 16384, 0);
 
            swFeatMgr = Part.FeatureManager;
 
            swFeatData = (FillPatternFeatureData)swFeatMgr.CreateDefinition((int)swFeatureNameID_e.swFmFillPattern);
            swFeatData.CreateSeedCutPolygonSides = 0;
            swFeatData.CreateSeedCutType = 0;
            swFeatData.Diagonal = 0.008;
            swFeatData.Diameter = 0.008;
            swFeatData.Dimension = 0.00565685424949238;
            swFeatData.FeaturesToPatternType = 0;
            swFeatData.GeometryPattern = false;
            swFeatData.InnerRadius = 0.00380422606518061;
            swFeatData.InstanceSpacing = 0.0170240490494193;
            swFeatData.LayoutSpacingType = 1;
            swFeatData.LoopSpacing = 0.0170240490494193;
            swFeatData.Margins = 0;
            swFeatData.NoOfInstances = 10;
            swFeatData.OuterRadius = 0.004;
            swFeatData.PatternLayoutPolygonSides = 0;
            swFeatData.PatternLayoutType = 0;
            swFeatData.Rotation = 0;
            swFeatData.SeedCutFlipShapeDirection = false;
            swFeatData.StaggerAngle = 1.0471975511966;
            swFeat = swFeatMgr.CreateFeature(swFeatData);
 
        }
 
        /// <summary>
        /// The SldWorks swApp variable is pre-assigned for you.
        /// </summary>
        public SldWorks swApp;
    }
}

 


Provide feedback on this topic

SOLIDWORKS welcomes your feedback concerning the presentation, accuracy, and thoroughness of the documentation. Use the form below to send your comments and suggestions about this topic directly to our documentation team. The documentation team cannot answer technical support questions. Click here for information about technical support.

* Required

 
*Email:  
Subject:   Feedback on Help Topics
Page:   Create Fill Pattern Example (C#)
*Comment:  
*   I acknowledge I have read and I hereby accept the privacy policy under which my Personal Data will be used by Dassault Systèmes

Print Topic

Select the scope of content to print:

x

We have detected you are using a browser version older than Internet Explorer 7. For optimized display, we suggest upgrading your browser to Internet Explorer 7 or newer.

 Never show this message again
x

Web Help Content Version: API Help (English only) 2023 SP05

To disable Web help from within SOLIDWORKS and use local help instead, click Help > Use SOLIDWORKS Web Help.

To report problems encountered with the Web help interface and search, contact your local support representative. To provide feedback on individual help topics, use the “Feedback on this topic” link on the individual topic page.