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Add and Edit Misaligned Symmetric Concentric Mate Example (VB.NET)

This example shows how to add and edit a misaligned symmetric concentric mate between components.

'-----------------------------------------------------------------
' Preconditions:
' 1. Verify that the parts to open and assembly template exist.
' 2. Open a new session of SOLIDWORKS to ensure that the assembly
'    document's title is Assem1.
' 3. Open the Immediate window.
'
' Postconditions:
' 1. Opens wheel_hub.sldprt.
' 2. Opens a new assembly document titled Assem1 and adds 
'    wheel_hub.sldprt as a component.
' 3. Opens and adds beam with holes.sldprt as another component.
' 4. Adds a concentric mate between the components.
' 5. Adds a misaligned symmetric concentric mate
'    between the components.
' 6. Edits the misaligned symmetric concentric mate.
' 7. Examine the Immediate window, graphics area, and the mates
'    in the Mates folder in the FeatureManager design tree.
'
' NOTE: Because the parts are used elsewhere, do not save changes.
'-----------------------------------------------------------------
Imports SolidWorks.Interop.sldworks
Imports SolidWorks.Interop.swconst
Imports System.Runtime.InteropServices
Imports System
Imports System.Diagnostics
 
Partial Class SolidWorksMacro
 
    Public Sub main()
 
        Dim swModel As ModelDoc2
        Dim swAssembly As AssemblyDoc
        Dim swInsertedComponent As Component2
        Dim swMathUtil As MathUtility
        Dim swTransform As MathTransform
        Dim swModelDocExt As ModelDocExtension
        Dim swMate As Mate2
Dim swLinkedMate As Mate2
        Dim swComp As Component2
        Dim swSelectionManager As SelectionMgr
        Dim swFeature As Feature
        Dim status As Boolean
        Dim errors As Integer
        Dim warnings As Integer
        Dim fileName As String
        Dim swSheetWidth As Double
        Dim swSheetHeight As Double
        Dim AssemblyTitle As String
        Dim TransformData(15) As Double
        Dim TransformDataObj As Object
 
        'Open the part
        fileName = "C:\Users\Public\Documents\SOLIDWORKS\SOLIDWORKS 2018\samples\tutorial\api\wheel_hub.sldprt"
        swModel = swApp.OpenDoc6(fileName, swDocumentTypes_e.swDocPART, swOpenDocOptions_e.swOpenDocOptions_Silent, "", errors, warnings)
        swApp.ActivateDoc2("wheel_hub.sldprt", False, errors)
 
        'Create an assembly
        swSheetWidth = 0
        swSheetHeight = 0
        swAssembly = swApp.NewDocument("C:\ProgramData\SolidWorks\SOLIDWORKS 2018\templates\Assembly.asmdot", 0, swSheetWidth, swSheetHeight)
        AssemblyTitle = swAssembly.GetTitle
 
        'Add the part to the assembly
        swInsertedComponent = swAssembly.AddComponent5(fileName, swAddComponentConfigOptions_e.swAddComponentConfigOptions_CurrentSelectedConfig, "", False, "", -0.000181145833835217, 0.000107469465717713, 0.0000225750183631135)
        swApp.CloseDoc(fileName)
        TransformData(0) = 1
        TransformData(1) = 0
        TransformData(2) = 0
        TransformData(3) = 0
        TransformData(4) = 1
        TransformData(5) = 0
        TransformData(6) = 0
        TransformData(7) = 0
        TransformData(8) = 1
        TransformData(9) = 0
        TransformData(10) = 0
        TransformData(11) = 0
        TransformData(12) = 1
        TransformData(13) = 0
        TransformData(14) = 0
        TransformData(15) = 0
        TransformDataObj = TransformData
        swMathUtil = swApp.GetMathUtility()
        swTransform = swMathUtil.CreateTransform((TransformDataObj))
        status = swInsertedComponent.SetTransformAndSolve2(swTransform)
 
        'Open and add another part to the assembly
        fileName = "C:\Users\Public\Documents\SOLIDWORKS\SOLIDWORKS 2018\samples\tutorial\api\beam with holes.sldprt"
        swApp.OpenDoc6(fileName, swDocumentTypes_e.swDocPART, swOpenDocOptions_e.swOpenDocOptions_AutoMissingConfig, "", errors, warnings)
        swModel = swApp.ActivateDoc3(AssemblyTitle, True, 0, errors)
        swAssembly = swModel
        swInsertedComponent = swAssembly.AddComponent5(fileName, swAddComponentConfigOptions_e.swAddComponentConfigOptions_CurrentSelectedConfig, "", False, "", -0.0543800538871437, -0.10948954091873, 0.0944189997389913)
        swApp.CloseDoc(fileName)
        TransformData(0) = 1
        TransformData(1) = 0
        TransformData(2) = 0
        TransformData(3) = 0
        TransformData(4) = 1
        TransformData(5) = 0
        TransformData(6) = 0
        TransformData(7) = 0
        TransformData(8) = 1
        TransformData(9) = -0.179380053887144
        TransformData(10) = -0.0894895409187302
        TransformData(11) = 0.0744189997389913
        TransformData(12) = 1
        TransformData(13) = 0
        TransformData(14) = 0
        TransformData(15) = 0
        TransformDataObj = TransformData
        swMathUtil = swApp.GetMathUtility()
        swTransform = swMathUtil.CreateTransform((TransformDataObj))
 
        'Add a concentric mate
        swModelDocExt = swModel.Extension
        status = swModelDocExt.SelectByRay(-0.158811046822791, -0.11180606883903, 0.110029416510201, -0.400036026779312, -0.515038074910024, -0.758094294050284, 0.000877710636365774, 2, True, 1, 0)
        status = swModelDocExt.SelectByRay(-0.0595820179927387, -0.0282041473137156, 0.0120989536100637, -0.400036026779312, -0.515038074910024, -0.758094294050284, 0.000877710636365774, 2, True, 1, 0)
        swMate = swAssembly.AddMate5(swMateType_e.swMateCONCENTRIC, swMateAlign_e.swMateAlignALIGNED, False, 0.128546596088087, 0.0254, 0.0254, 0.0254, 0.0254, 0, 0.5235987755983, 0.5235987755983, False, False, 0, errors)
        swModel.ClearSelection2(True)
        swModel.EditRebuild3()
 
        'Move a component in order to add another mate
        status = swModelDocExt.SelectByID2("beam with holes-1@Assem1", "COMPONENT", 0, 0, 0, False, 0, Nothing, 0)
        TransformData(0) = 0.999268594246539
        TransformData(1) = -0.0382397247969312
        TransformData(2) = 0
        TransformData(3) = 0.0382397247969312
        TransformData(4) = 0.999268594246539
        TransformData(5) = 0
        TransformData(6) = 0
        TransformData(7) = 0
        TransformData(8) = 1
        TransformData(9) = -0.0817169203602251
        TransformData(10) = -0.00405863499514564
        TransformData(11) = 0.158954897029145
        TransformData(12) = 1
        TransformData(13) = 0
        TransformData(14) = 0
        TransformData(15) = 0
        TransformDataObj = TransformData
        swMathUtil = swApp.GetMathUtility()
        swTransform = swMathUtil.CreateTransform((TransformDataObj))
        swSelectionManager = swModel.SelectionManager
        swComp = swSelectionManager.GetSelectedObjectsComponent4(1, -1)
        status = swComp.SetTransformAndSolve2(swTransform)

        'Add a misaligned symmetric concentric mate
        status = swModelDocExt.SelectByRay(-0.0362917984178921, -0.0292363280984205, 0.194521666713399, -0.400036026779312, -0.515038074910024, -0.758094294050284, 0.000877710636365774, 2, True, 1, 0)
        status = swModelDocExt.SelectByRay(0.054967212945769, -0.0278611795938559, 0.0112380964281442, -0.400036026779312, -0.515038074910024, -0.758094294050284, 0.000877710636365774, 2, True, 1, 0)
         Debug.Print("Misaligned concentric mate:")
        swMate = swAssembly.AddConcentricMateWithTolerance(swMateAlign_e.swMateAlignALIGNED, swConcentricAlignmentType_e.swConcentricAlignSymmetric, False, 0, errors)
        If errors = 1 Then
            Debug.Print("  Added")
        Else
            Debug.Print("  Not added")
        End If
 
        swModel.ClearSelection2(True)
 
        'Edit the misaligned symmetric concentric mate
        'and change its position from symmetric to aligned
        status = swModelDocExt.SelectByRay(0.0548392523382404, -0.0277425865184, 0.00906375356890976, -0.400036026779312, -0.515038074910024, -0.758094294050284, 0.00107347349835279, 2, False, 0, 0)
        status = swModelDocExt.SelectByRay(0.00980255664001106, -0.0292099642897483, 0.193646683964346, -0.400036026779312, -0.515038074910024, -0.758094294050284, 0.00107347349835279, 2, True, 0, 0)
        status = swModelDocExt.SelectByID2("Concentric2", "MATE", 0, 0, 0, True, 0, Nothing, 0)
        swAssembly.EditConcentricMate(swMateAlign_e.swMateAlignALIGNED, swConcentricAlignmentType_e.swConcentricAlignThisMate, True, 0.095, errors)
 
        swModel.ClearSelection2(True)
 
        If errors = 1 Then
            Debug.Print("  Edited")
            status = swModelDocExt.SelectByID2("Concentric2", "MATE", 0, 0, 0, True, 0, Nothing, 0)
            swFeature = swSelectionManager.GetSelectedObject6(1, -1)
            swMate = swFeature.GetSpecificFeature2
            
            'Get the linked concentric mate
            swLinkedMate = swMate.GetLinkedMate
            'Get current misaligned deviation
            Debug.Print("    Current misalignment deviation: " & swLinkedMate.GetCurrentMisalignedDeviation)
            'Do not use document property value for misalignment deviation
            swMate.SetUseMisalignedDeviationDocumentProperty(False)
            Debug.Print("    Use document property? " & swMate.GetUseMisalignedDeviationDocumentProperty)
            'Change mate alignment type to symmetric
            swLinkedMate.SetConcentricAlignmentType(swConcentricAlignmentType_e.swConcentricAlignSymmetric)
            Debug.Print("    Concentric alignment type as defined in swConcentricAlignmentType_e: " & swLinkedMate.GetConcentricAlignmentType)
            'Set maximum misalignment deviation
            swMate.SetMaximumMisalignedDeviation(0.102)
            Debug.Print("    Maximum misalignment deviation: " & swMate.GetMaximumMisalignedDeviation)
        Else
            Debug.Print("  Not edited")
        End If
        swModel.ClearSelection2(True)
        swModel.EditRebuild3()
 
    End Sub
 
    ''' <summary>
    ''' The SldWorks swApp variable is pre-assigned for you.
    ''' </summary>
    Public swApp As SldWorks
 
 
End Class
 



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