You create sub-weldments to segment complex weldment models into more manageable entities.

Sub-weldments can include any entity listed in the Cut list folder fm_cutlist_needs_update.png, including structural members, end caps, gussets, weld fillet beads, and structural members trimmed with the Trim/Extend tool_Trim_Extend_Weldment.gif tool.

When you create subweldments, or when you save weldment bodies to new parts, the cut list properties from the parents propagate to the subweldments or new parts. In the Cut-List Properties dialog box, the Value / Text Expression of the properties appear as Linked to Parent Part - parent .sldprt. You cannot edit the cut list properties unless you break the reference to the parent part.

Creating Sub-weldments

To create a sub-weldment:

  1. In the FeatureManager design tree of the weldment model, expand Cut list .
  2. Expand the cut list folder .
  3. Select the entities to include in the sub-weldment, using Shift or Ctrl to group-select.
    The selected entities highlight in the graphics area.
  4. Right-click and select Create sub-weldment.
    A sub-weldment folder containing the selected entities appears under the Cut list folder .
  5. Right-click the sub-weldment folder and select Insert into New Part.
  6. In the PropertyManager, click .
    The sub-weldment model opens in a new SOLIDWORKS window, and the Save As dialog box appears. 3DEXPERIENCE Users: If the Save As New dialog box appears, click Save to This PC.
  7. Accept or edit the name for File name, and click Save.
    Changes made in the weldment model propagate to the sub-weldment model.