You can specify configuration properties such as name, description,
and BOM options in the
ConfigurationManager:
CAD Family tab.
This information applies to SOLIDWORKS
if you enable the Design with SOLIDWORKS app.
When you create configurations manually, you use the Add Physical Product PropertyManager. When you edit
a configuration, you use the Physical Product
Properties PropertyManager. Different options are available when you
create or edit configurations for parts and assemblies.
To create a configuration in the ConfigurationManager: CAD Family tab 
click
Inserts new physical product
.
To edit a configuration, right-click a physical product and click Edit Physical Product
.
Physical Product Properties
| Name |
Specifies the Physical Product name. Do not use
a
forward slash
(/),
a leading space, a trailing space,
or
an "at" sign (@) in the name. A warning
message appears when you close the PropertyManager if the
name is blank, contains invalid characters, or already
exists.
|
| Description |
(Optional) Specifies a
description that identifies the configuration when you view
configuration properties. |
| Suppress new features and mates |
(Assemblies only) Suppresses
new mates and features in this configuration that are added to
other configurations. When cleared, includes the new, resolved
mates and features in this configuration. New features in assemblies include assembly feature cuts
and holes, component patterns, reference geometry, and
sketches. These features belong to the assembly and not to
an assembly component.
|
| Suppress new components |
(Assemblies only) Suppresses
new components in this configuration that are added to other
configurations. When cleared, includes the new, resolved
components in this configuration. |
| Suppress new
features |
(Parts only) Suppresses new features in this
configuration that are added to other configurations. When
cleared, includes the new features in this configuration.
|
Bill of Materials Options
| Set 'Exclude from bill
of materials' when inserted into assembly |
(Assemblies
only) Excludes a component, configuration, or
model from the bill of materials. When you
select this option, the exclusion occurs the next time you
insert the component, configuration, or model.
|
| Child
component display when used as a subassembly |
(Assemblies only) When you use the
configuration of the assembly as a subassembly in another assembly,
the settings are used with the BOM
Type settings in the Bill of Materials
PropertyManager. The settings control if and how the child
components appear in a BOM of the top-level assembly. Select an
option:
|
Show
|
Shows the child components in the BOM if
dictated by BOM
Type in the Bill of Materials
PropertyManager. Child components do not show in a
Top-level
only BOM.
|
|
Hide
|
Hides the child components in the BOM,
even if BOM Type
shows them. The subassembly appears as a single item in
the BOM. For example, a Parts only BOM lists child components
as individual items. If you select Hide, the subassembly
is listed instead.
|
|
Promote
|
Dissolves the subassembly in the BOM and shows the child components,
even if the BOM
Type does not show them. For example, a
Top-level
only BOM lists the subassembly and not
the child components. If you select Promote, the Top-level only BOM
lists the child components and does not list the
subassembly.
|
|