Using a 3D Sketch to Create an Oven Rack Frame

In this lesson, you build the outer frame of a wire oven rack by sweeping a circle along a 3D sketch. After you complete half of the rack, you use the Mirror All function to finish the model.

First create the 3D sketch of the outer frame.

  1. Click New (Standard toolbar) and create a new part.
  2. Click 3D Sketch (Sketch toolbar) or Insert > 3D Sketch.
  3. Click Line (Sketch toolbar) and sketch a line about 135mm long on the XY plane from the origin. The pointer changes to while sketching horizontally on the XY plane.
    Sketch the line to an approximate length, then dimension to the exact length later.
  4. Click Select (Standard toolbar) or Tools > Selection > Select, and select the beginning endpoint of the line.
  5. In the PropertyManager, make sure that the endpoint is exactly at the origin (0, 0, 0 as shown under Parameters), is Coincident with the origin (as shown in Existing Relations) and is Fully Defined (as shown in Information ).
  6. If the endpoint is not at the origin:
    1. Under Parameters, set X Coordinate, Y Coordinate, and Z Coordinate to 0.
    2. Click Fix in Add Relations.
      Now the point is Fully Defined, as shown in Information .
  7. Zoom out to provide open sketching area on the right side of the graphics area.