Create ConvertSolid Feature Example (C#)

This example shows how to convert a solid body to sheet metal.

// ------------------------------------------------------------------

// Preconditions:

// 1. Open public_documents\SOLIDWORKS\SOLIDWORKS 2025\samples\tutorial\api\sweepcutextrude.sldprt.

// 2. Ensure that the Sheet Metal tab is visible on the Command Manager toolbar.

// 3. On the SOLIDWORKS toolbar, click Tools > Macro > New and create a C# macro.

// 4. Copy and paste the code below into SolidWorksMacro.cs.

// 5. Open an Immediate window.

//

// Postconditions:

// 1. Creates Convert-Solid1 and Sheet-Metal1.

// 2. Inspect the FeatureManager design tree and the Immediate window.

//

// NOTE: Because the model may be used elsewhere, do not save changes to it.

// -------------------------------------------------------------

 

using System;

using System.Collections.Generic;

using System.Diagnostics;

using System.Globalization;

using System.IO;

using System.Linq;

using System.Reflection;

using System.Runtime.CompilerServices;

using System.Security;

using System.Text;

using System.Threading.Tasks;

using SolidWorks.Interop.sldworks;

using SolidWorks.Interop.swconst;

using System.Runtime.InteropServices;

 

namespace ConvertToSheetMetal_CSharp

{

    partial class SolidWorksMacro

    {

        public void Main()

        {

            ModelDoc2 swModel;

            Feature swFeat;

            FeatureManager FeatMgr;

            ConvertSolidFeatureData swConvertSolidFeatData;

            ConvertSolidFeatureData FeatData;

            bool boolstatus;

            CustomBendAllowance cba;

            Face2 face;

            object faceId;

            object bendEdges;

 

            swModel = (ModelDoc2)swApp.ActiveDoc;

 

            FeatMgr = swModel.FeatureManager;

 

            boolstatus = swModel.Extension.SelectByID2("", "FACE", 0.0004130570195002, 0.02357994168921, 0.02568415695742, true, 0, null, 0);

            boolstatus = swModel.Extension.SelectByID2("", "EDGE", -0.00190522473838, 0.02387533864419, 0.04979931166838, true, 1, null, 0);

            boolstatus = swModel.Extension.SelectByID2("", "EDGE", 0.02911271681069, 0.02376277320678, 0.02892436699148, true, 1, null, 0);

            boolstatus = swModel.Extension.SelectByID2("", "EDGE", -0.004838857104858, 0.02387396382323, -0.0001997542986487, true, 1, null, 0);

 

            // Create a feature data object

            swConvertSolidFeatData = (ConvertSolidFeatureData)FeatMgr.CreateDefinition((int)swFeatureNameID_e.swFmSolidToSheetMetal);

 

            cba = (CustomBendAllowance)swConvertSolidFeatData.GetCustomBendAllowance();

 

            cba.Type = (int)swBendAllowanceTypes_e.swBendAllowanceKFactor;

            cba.KFactor = 0.08;

 

            // Initialize the feature data object with custom bend allowance

            swConvertSolidFeatData.Initialize(true, false, cba);

 

            // Create the feature

            swFeat = FeatMgr.CreateFeature(swConvertSolidFeatData);

 

            FeatData = (ConvertSolidFeatureData)swFeat.GetDefinition();

 

            cba = (CustomBendAllowance)swConvertSolidFeatData.GetCustomBendAllowance();

 

            Debug.Print("Type of custom bend allowance as defined in swBendAllowanceTypes_e: " + cba.Type);

            Debug.Print("K factor: " + cba.KFactor);

 

            Debug.Print("SheetMetal thickness : " + FeatData.SheetThickness);

            Debug.Print("Bend Radius  : " + FeatData.BendRadius);

            Debug.Print("Reverse thickness : " + FeatData.ReverseThickness);

            Debug.Print("Keep body : " + FeatData.KeepBody);

            Debug.Print("Overlap type : " + FeatData.CornerDefaults);

            Debug.Print("Rip gaps : " + FeatData.RipGap);

            Debug.Print("Rip overlap ratio : " + FeatData.RipOverlapRatio);

            Debug.Print("Auto relief type : " + FeatData.ReliefType);

            Debug.Print("Auto relief ratio : " + FeatData.ReliefRatio);

 

            bendEdges = FeatData.BendEdges;

            Debug.Print("Number of bend edges: " + FeatData.GetBendEdgesCount());

 

            FeatData.AccessSelections(swModel, null);

 

            face = (Face2)FeatData.GetFixedFace();

            faceId = face.GetFaceId();

            Debug.Print("Fixed face ID: " + faceId);

 

            // Modify initial values

            FeatData.SheetThickness = 0.014;

            FeatData.BendRadius = 0.0006;

 

            // Modify the feature definition

            swFeat.ModifyDefinition(FeatData, swModel, null);

 

            Debug.Print("----------------------------After Setting Values-------------------------------");

 

            Debug.Print("SheetMetal thickness : " + FeatData.SheetThickness);

            Debug.Print("Bend Radius  : " + FeatData.BendRadius);

            Debug.Print("Reverse thickness : " + FeatData.ReverseThickness);

            Debug.Print("Keep body : " + FeatData.KeepBody);

            Debug.Print("Overlap type : " + FeatData.CornerDefaults);

            Debug.Print("Rip gaps : " + FeatData.RipGap);

            Debug.Print("Rip overlap ratio : " + FeatData.RipOverlapRatio);

            Debug.Print("Auto relief type : " + FeatData.ReliefType);

            Debug.Print("Auto relief ratio : " + FeatData.ReliefRatio);

        }

 

        public SldWorks swApp;

    }

}