Splitting Out Configurations Into Individual Files

In parts or assemblies that have multiple configurations, you can split all the configurations out into individual part or assembly files and save those individual files. You can update the where-used references after the split.

1. Open a part or assembly that has multiple configurations.
2. In the ConfigurationManager , right-click the file name at the top of the tree or any configuration in the tree and click Split Configurations.
   The Split Configurations as New Files dialog box opens.
3. You can specify these options:

   Path	Displays the path to the part or assembly. This is noneditable.
   Update where used	Updates all the references of the original part in the assemblies or drawings to newly created single physical product files in open and out-of-memory files. If you clear this option, the Where used table is unavailable.
   Where used	Displays all open in-memory assemblies of the part or assembly being configured. If you select a check box, the software updates the references of the selected assemblies and drawings with the new split-out parts.
   File Locations	Opens the File Locations dialog box. You can update the Where used references of open and out-of-memory assembly and drawing files when the configurations are split.
   Total found	Displays the total number of configurations found and converted to individual files.
   Update for 3DExperience Compatibility	Creates single physical product files.

4. Click Save.
   All the configurations are split out into separate files that are in the same location as the original file. The file names are <original file name>.<configuration name>.SLDPRT or SLDASM. For example, for a part named BasePart.SLDPRT that has a split configuration named LongHandle, the split configuration name is BasePart.LongHandle.SLDPRT.