Dimension Value PropertyManager
In the Dimension Value PropertyManager,
you can specify the display of dimensions.
If you select multiple dimensions, only the properties that apply to all
the selected dimensions are available.
Dimension Assist Tools
Allows you to dimension a drawing with smart
or DimXpert
(for drawings) dimensioning. Click DimXpert
to access the DimXpert
(for drawings) and Autodimension
tabs.
Smart dimensioning 
. Lets you create dimensions with the Smart Dimension
tool.
DimXpert .
Lets you apply dimensions to fully define manufacturing features (patterns,
slots, pockets, fillets, etc.) and locating dimensions, using DimXpert for drawings.
Tolerance/Precision
Callout
value. Choose a value in the currently selected dimension. This
is available for dimensions with multiple values in the callout.
Tolerance Type 
. Select from the list. Selections available depend on the
type of dimension.
Maximum Variation 
.
Minimum Variation 
.
Unit Precision 
. Select the number of digits after the decimal point from
the list for the dimension value.
Tolerance Precision 
. Select the number of digits after the decimal point for
tolerance values.
Configurations. (Parts and assemblies only) Applies
the dimension tolerance to specific configurations for driven dimensions
only.
Classification 
. (Fit, Fit
with tolerance, or Fit (tolerance
only)) When you select either Hole
Fit or Shaft Fit (below),
the list for the other category (Hole
Fit or Shaft Fit) is filtered
based on the classification.
Hole Fit 
and Shaft Fit 
. (Fit,
Fit with tolerance, or Fit
(tolerance only)) Select from the lists, or type any text.
NOTE: Bilateral tolerances (Maximum Variation and Minimum
Variation) are available in the Fit
with tolerance or Fit (tolerance
only) type if you specify Hole
Fit or
Shaft Fit, but not both.
Fit tolerance display. (Fit,
Fit with tolerance,
or Fit (tolerance only))
Stacked
with line display.
Stacked
without line display.
Linear
display.
Show parentheses. Parentheses
are available for Bilateral, Symmetric, and Fit
with tolerance tolerance
types. Parentheses are available for Fit
with tolerance if you specify Hole
Fit or
Shaft Fit, but not both.
2nd Tolerance/Precision
Available for chamfer
dimensions.
Primary Value
Primary
Value is displayed for driving
dimensions and can be changed to alter the model. You can override
the dimension value. For dimensions that are not referenced, you can change
the dimension name. Driven (reference)
dimensions list a value and name, but you cannot change them.
Name.
The name of the selected dimension.
Dimension
value. The value of the selected dimension.
Override
value. Select to override the primary value, and type a new value.
If you clear Override value, the
dimension returns to its original value but retains the tolerance. Override
values do not automatically update when geometry changes.
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Original value |
Overridden value |
Reverse
Direction 
. Change the dimension direction between
positive and negative sense.
Dimension Text
Text. The dimension appears
automatically in the center text box, represented by <DIM>.
Place the pointer anywhere in the text box to insert text. If you delete
<DIM>, you can reinsert
the value by clicking Add Value 
.
For some types of dimensions,
additional text appears automatically. For example, a Hole
Callout for a counterbore hole displays the diameter and depth
of the hole (<MOD-DIAM><DIM><HOLE-DEPTH>xx).
Hole
Callouts for holes created in the Hole Wizard display information
from the Hole Wizard. You can edit the text and insert variables from
the Callout
Variables dialog box.
Justify. You can justify text
horizontally and, for some standards, you can justify the leader vertically.
Symbols. Click to place the
pointer where you want a standard symbol. Click a symbol icon or click
More to access the .
Chamfer Dimension Display.
Distance
X Distance.
Distance
X Angle.
Angle X Distance.
C
Distance. Available only
for chamfers with 45° angles.
Dual Dimension
|
Specifies
that the dimension is displayed in both the document's unit system and
the dual dimension units. Both units are specified in Document
Properties Units. You set
where the alternate units are displayed in Document
Properties - Dimensions. Dual dimensions are displayed in brackets. |
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Unit Precision . Select the number of digits after the decimal point from
the list for the dimension value.
Tolerance Precision  . Select the number of digits after the decimal point for
tolerance values. |