Sketch
When you
open a new part document, first you create a sketch. The sketch is the
basis for a 3D model. You can create a sketch on any of the default planes
(Front Plane, Top
Plane, and Right Plane),
or a created
plane. You
can start by selecting:
You can also create a sketch on a flat surface,
a spline
on a surface, or the face of a solid.
To start a sketch with a sketch
entity tool or with the Sketch tool:
Click
a sketch entity tool (line, circle, and so on) on the Sketch
toolbar.
- or -
Click Sketch
on the Sketch toolbar, or click Insert,
Sketch.
Select one of the three
planes (Front Plane, Top
Plane, and Right Plane)
displayed.
In new parts, the plane rotates
to the Normal to orientation.
Create
a sketch with the sketch entity tool, or select a tool on the Sketch toolbar
and create a sketch.
Dimension
the sketch entities.
Exit the sketch, or click Extruded
Boss/Base or Revolved
Boss/Base on the Features toolbar.
To start a sketch with a plane:
Select
a plane in the FeatureManager design tree and click a sketch entity tool
or click Sketch on the Sketch toolbar.
In new parts, the plane is
displayed in Normal to orientation.
Create
the sketch, and follow steps 4 and 5 from the previous procedure.
To start a sketch with an Extruded
or Revolved Boss/Base:
Click Extruded
Boss/Base or Revolved
Boss/Base on the Features toolbar, or click Insert, Boss/Base,
Extrude or Boss/Base,
Revolve.
Select one of the
three planes (Front Plane, Top Plane, and Right
Plane) displayed.
In new parts, the plane
rotates to the Normal to orientation.
Create
a sketch with the sketch entity tool, or select a tool on the Sketch toolbar
and create a sketch.
The sketch must be a closed sketch.
Close the
sketch to open the PropertyManager of the feature you selected.
Create
the part and click OK .
To edit
an existing sketch:
- or -
To create a new sketch in a
part with existing sketches:
Click a
sketch tool on the Sketch toolbar, such as Rectangle .
- or -
Click Sketch on the Sketch toolbar, or click Insert,
Sketch.
Click a
plane, face, or edge to add a new sketch, or click Base/Boss Extrude
or Base/Boss Revolve
.
If you
clicked Sketch in step 1, or a feature in step 2, click a tool on
the Sketch toolbar to create the sketch.
Create
the sketch, and dimension
the sketch entities.
Exit
the sketch, or click Extruded
Boss/Base or Revolved
Boss/Base on the Features toolbar.
You can also create a new sketch
by extracting entities from an existing sketch.
Related Topics
Where
to Start a Sketch
Sketch
Complexity
Sketch
Options
Sketch
Geometry Status
Using
3D Sketching Tools