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Creating a Mirrored Sheet Metal Part

The Mirror Part command now supports sheet metal parts. When you mirror a sheet metal part, a new part is created. You can copy the features of the original part to the mirrored part by breaking the link to the original part. The copied sheet metal features are added to the FeatureManager design tree of the new part.

To create a mirrored sheet metal part:

  1. Open install_dir\samples\whatsnew\Sheetmetal\corner.sldprt.
  2. Select the Front Plane and click Insert > Mirror Part.

    A new part opens.

  3. In the Insert Part PropertyManager:
    1. Under Link, click Break link to original part.

      The source part is visible in the graphics area.

    2. Click .

      The part appears in the graphics area mirrored around the plane.

    3. Click to close the Locate Part PropertyManager.
  4. Save the part as corner_mirrored.sldprt.
  5. In the FeatureManager design tree, expand corner_Mirrored Features1.

    The features of the original part are displayed and are fully editable.

    You can also access the features by expanding Cut list(1) > Body-Move/Copy1.

  6. Keep this part open for use in the next section.


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