Dome
You can create one or more dome features simultaneously on the same
model. The Parameters in the dome
PropertyManager include:
you can apply domes to faces
whose centroid lies outside the face. This allows you to apply domes to
irregularly shaped contours.
Distance.
Set a value for the distance
by which the dome expands.
Reverse Direction . Click to
create a concave dome (default is convex).
Constraint Point or
Sketch . Control the dome
feature by selecting a sketch that contains points to constrain the shape
of the sketch. When you use a sketch containing points as a constraint,
the Distance is disabled.
Direction.
Click Direction , and select a direction vector from the graphics area to
extrude the dome in a direction other than normal to the face. As a direction
vector, you can use a linear edge or the vector created by two sketch
points.
Elliptical dome.
Specify an elliptical
dome
for cylindrical or conical models. An elliptical dome's shape is a half
ellipsoid, with a height equal to one of the ellipsoid radii.
Continuous dome.
Specify a continuous
dome
for polygonal models. A continuous dome's shape slopes upwards, evenly
on all sides. If you clear Continuous
dome, the shape rises normal to the edges of the polygon.
Continuous
dome is not available for four-sided polygons or when you use a Constraint
Point or Sketch or a Direction
vector.
On cylindrical and conical models, you can set Distance
to 0. The software calculates
the distance using the radius of the arc as a basis for the dome. It creates
a dome that is tangent to the adjacent cylindrical
or conical
face.
To create a dome:
Click Dome
on the Features toolbar, or click Insert,
Features, Dome.
In the PropertyManager, under Parameters,
follow the guidelines listed above.
Click OK
.