> Sketching > Sketch Tools > Mirror Sketch Entities
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Mirror Entities

General Capabilities

Applies to 2D sketches and 2D sketches created on 3D sketch planes.

  • Mirror to only include the new entity, or both the original and the mirrored entity.

  • Mirror some or all of the sketch entities.

  • Mirror about any type of line, not just a construction line.

  • Mirror about edges in a drawing, part, or assembly.

When you create mirrored entities, the SolidWorks software applies a symmetric relation between each corresponding pair of sketch points (the ends of mirrored lines, the centers of arcs, and so on). If you change a mirrored entity, its mirror image also changes.

Conditions for  2D Sketches on 3D Sketch Planes

  • Sketch line. Constrained to the current sketch plane.

  • Model edge. Sketched on the current sketch plane.

To mirror existing sketch entities:

  1. In an open sketch, click Mirror Entities (Sketch toolbar) or Tools, Sketch Tools, Mirror.

  2. In the PropertyManager:

    1. Select sketch entities for Entities to Mirror .

    2. Clear Copy to add a mirror copy of the selected entities and remove the original sketch entities.

- or -

Select Copy to include both the mirrored copy and the original sketch entities.

    1. Select an edge or a line to Mirror about .

  1. Click OK .

To mirror sketch entities as you sketch them:

  1. Select a line or a model edge in an open sketch.

  2. Click Dynamic Mirror Entities art\MIRRORTL.gif (Sketch toolbar) or Tools, Sketch Tools, Dynamic Mirror.

Symmetry symbols appear at both ends of the line or edge.

  1. Create the sketch entities that you want to mirror. The entities are mirrored as you sketch them.

  2. To turn mirroring off, click Dynamic Mirror Entities art\MIRRORTL.gif again.



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