Converting a Shelled Solid Body to a Sheet Metal Part
It is possible to create a solid part, then convert it to sheet metal
to add the bends and sheet metal features.
To create a part of uniform thickness and convert it
to sheet metal:
Create a block with
the Extruded Boss/Base
tool. Make the block 50mm on all sides.
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Shell
the block to 1mm so the part is of uniform thickness. In Faces
to Remove, select the faces as shown.
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To bend the part, rip the block between
the edges of the tabs by clicking Rip or Insert, Sheet
Metal, Rip. Select the
edge to rip as shown.
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Convert the part to sheet metal by clicking
Insert
Bends or Insert,
Sheet Metal, Bends.
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If you want to make
a cut across a bend, drag the Rollback
Bar before the Process-Bends
feature in the FeatureManager design tree.
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Sketch a closed profile
across one of the bends.
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Extrude the cut
Through All.
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To restore the part
to the bent state, drag the rollback bar to the bottom of the FeatureManager
design tree.
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