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Sketch Relations in Configurations

You can control the suppression state of sketch relations per configuration.

To suppress or unsuppress sketch relations:

  1. Right-click a sketch in the FeatureManager design tree, and select Edit Sketch.

  2. Click Display/Delete Relations on the Dimensions/Relations toolbar.

  3. In the PropertyManager, under Configurations (at the bottom of the PropertyManager), select the configurations to which you want the sketch relations to apply: This configuration, All configurations, or Specify configurations (these options are only available if there is more than one configuration in the model).


    • You must select a configuration prior to changing sketch relations. When you change sketch relations, the change is immediately applied to the selected configuration.

    • If you selected Specify configurations, you cannot clear the active configuration.


  1. Under Relations, select the sketch relations to suppress or unsuppress.

  2. Select or clear Suppressed.

    When Suppressed is selected, the sketch relation's Information Status changes from Satisfied to Driven.

  3. Click OK , and exit the sketch.

    The sketch relation is applied to the selected configurations.

To suppress or unsuppress sketch relations in a design table:

The column header in a design table for controlling sketch relations uses this syntax:


For example, to control the suppression state of the first fixed relation in Sketch2, the column heading syntax is $STATE@Fixed1@Sketch2.

The column header is not case sensitive.

In the table body cells, type S for suppressed or U for unsuppressed.

Sketch relations and sketch entities include an assigned number (such as Fixed1) in the Display/Delete Relations PropertyManager.

Example of a design table that controls the suppression state of a sketch relation:

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