Creating a Joined
Part
In an assembly, you can join
two or more parts to create a new part. The join operation removes surfaces
that intrude into each other's space, and merges the part bodies into
a single solid volume.
To join parts:
Create the parts that you want to join, then create
an assembly containing the parts.
Position the parts as
desired in the assembly. The parts may either touch each other or intrude
into one another.
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![art\jn1_shg.gif](../art/jn1_shg.gif)
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Save the
assembly but do not close the window.
Insert a new part into the assembly:
Click New
Part on the Assembly toolbar, or click Insert,
Component, New
Part.
Click a plane or
planar face on a component.
In the new part, a sketch opens on the selected plane.
|
![art\jn2_shg.gif](../art/jn2_shg.gif)
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Close the sketch. Because you are creating a joined
part, you do not need the sketch.
In the FeatureManager design tree, right-click
the new part name, select Rename Part,
and rename the new part.
Click Insert,
Features, Join.
Make selections and set options in the Join
PropertyManager.
Click to create the joined part.
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![art\jn3_shg.gif](../art/jn3_shg.gif)
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![art\jn4_shg.gif](../art/jn4_shg.gif)
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Before join - coincident faces |
After Join - faces are removed |
To
return to editing the assembly, right-click the assembly name in the FeatureManager
design tree, or right-click anywhere in the graphics area, and select
Edit Assembly:<assembly_name>,
or click Edit Component
on the Assembly toolbar.
The joined part
is fully associative to the original parts and to the assembly. Any changes
made to the original parts are reflected in the joined part. If the parts
move relative to each other in the assembly, the joined part changes also.