Note PropertyManager
Use the Note PropertyManager
to insert a Note,
or to edit an existing note, balloon
note, or revision
symbol.
Style
In addition to the functionality
described in Style,
notes have two types of favorite styles:
With text.
If you type text in a note and save it as a style, the text is saved with
the note properties. When you create a new note, select the favorite,
and place the note in the graphics area, the note appears with the text.
If you select text in the document and then select a style, the properties
of the style are applied without changing the selected text.
Without
text. If you create a note without text and save it as a style, only the
note properties are saved.
Text Format
Align the text horizontally using
Left Align
, Center Align
, or Right Align
.
Align the text vertically by
selecting Top Align
, Middle
Align
, Bottom
Align
.
Fit
Text
Click to compress or expand selected text.
Angle
. A positive
angle rotates the note counterclockwise.
![](../art_english/note_angle.gif)
Insert
Hyperlink
. Adds a hyperlink to the note. The
entire note becomes a hyperlink. Underlining is not automatic, but you
can add it by clearing Use document font
and clicking Font.
![](../art_english/note_hyperlink.gif)
Link
to Property
. Lets you access drawing properties
and component properties so you can add them to the text string. Only
properties added to parts, assemblies, and drawings are available.
Add Symbol
.
Lets you access the symbol libraries so you can add symbols to text. Place
the pointer in the note text box where you want the symbol to appear,
then click Add
Symbol:
![](../art_local/note_w_symbol.gif)
Lock/Unlock
note
(Available in drawings only.) Fixes the note
in place. When you edit the note, you can adjust
the bounding box, but you cannot move the note itself.
Insert
Geometric Tolerance
. Inserts a geometric tolerance
symbol into the note. The Geometric Tolerance PropertyManager
and the Properties
dialog box open so you can define the symbol.
Insert
Surface Finish Symbol
. Inserts a surface finish
symbol into the note. The Surface
Finish PropertyManager opens so you can define the symbol.
Insert
Datum Feature
. Inserts a datum feature symbol into
the note. The Datum
Feature PropertyManager opens so you can define the symbol.
If there is an
existing geometric tolerance, surface finish, or datum feature symbol
in the drawing, you can click the symbol while you edit the note to insert
the symbol in the note. To edit the symbol, you must edit the existing
symbol in the drawing sheet. When you edit the existing symbol, all instances
of the symbol are updated in the sheet.
Manual
view label (for projected, detail, section, aligned section, and
auxiliary view labels only). Overrides the options in Document Properties
- View Labels.
When selected, you can edit the label text. If you later clear the check
box, the label updates according to the corresponding View
Label options.
Use document font. Uses the
font specified in .
Font. When Use
document font is cleared, click Font
to open the Choose Font dialog
box. Select a new font style, size, and other text effects.
Include prefix, suffix and tolerance
of dimensions. When selected, if you insert a dimension into a
note, any symbols or tolerances included with the dimension appear in
the note. When cleared, the dimension appears in the note, but any symbols
or tolerances are omitted.
Block Attribute
You can add attribute names to
notes in blocks. Attributes are similar to properties in a part, drawing,
or assembly.
The Block Attribute section
is available only when editing a note (below, "FW") in a block.
![](../art/block_w_attributes.gif)
Attribute name. Select a note
in the block. Text appears in this box for notes with attributes imported
from AutoCAD. You can type or edit the attribute name in the text field
provided.
You can choose for an attribute to be Read
only, Invisible, or both.
Clear Read only to change the
Attribute name for each block
instance.
You can edit
this attribute/value pair from the Block PropertyManager.
Choose a note leader:
Leader
, to create a simple leader from the note to the drawing
Multi-jog leader
, to create
a leader from the note to the drawing with one or more bends
No Leader
![](../art_pm/PM_note_NoLeader.gif)
Auto Leader
automatically inserts a leader if you select an entity
such as a model or sketch edge.
Choose leader origin:
Leader Left
originates from the left of the note
Leader
Right
originates
from the right of the note
Leader Nearest
originates from the left or right of the note, depending
on which is closest
Choose whether the leader is straight, bent, or underlined:
Straight Leader
![](../art_pm/PM_LEADER_STRAIGHT.gif)
Bent Leader
![](../art_pm/pm_leader_bent.gif)
Underlined Leader
![](../art_pm/pm_leader_underline.gif)
Select an arrowhead style from Arrow
Style. Smart arrowhead
applies
the appropriate arrowhead depending on the detailing standard.
Select Apply to all to apply
a change to all of the arrowheads of the selected note. If the selected
note has ,
and Auto Leader is not selected,
you can use a different arrowhead style for each individual leader.
Leader/Frame Style
Use document
display
Border
Style.
Specifies a geometric shape (or None)
to enclose the text. You can apply borders to entire notes and portions
of notes. For portions of notes, select any portion of the note and select
a border. See Balloon
Styles and Sizes for more examples.
![](../art/note_w_border.gif)
Triangle border style |
Size.
Specifies either Tight Fit to
the text, or a fixed number of characters.
Parameters
Enter the location for the note center in X Coordinate
and Y Coordinate
, or select
Display
on the screen to enter the note position in the graphics area.
With Display on the screen, the
X and Y coordinates are shown in the graphics area where you can type
coordinates. The (0,0) position is the lower left corner of the drawing
sheet.
![](../art/note_display_on_screen.gif)
Layer
In drawings with named layers,
select a Layer
.