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Intersection Curve

Intersection Curve art\skt_icv.gif opens a sketch and creates a sketched curve at the following kinds of intersections:

  • A plane and a surface or a model face

  • Two surfaces

  • A surface and a model face

  • A plane and the entire part

  • A surface and the entire part

You can use the resulting sketched intersection curve in the same way that you use any sketched curve, including the following tasks:

  • Measure thickness at various cross sections of a part. (See steps below.)

  • Create sweep paths that represent the intersection of a plane and the part.

  • Make sections out of imported solids to create parametric parts.

To use the sketched curve to extrude a feature, the sketch that opens must be a 2D sketch. Other tasks can be performed using a 3D sketch.

  • To open a 2D sketch, select the plane first then click Intersection Curve.

  • To open a 3D sketch, click Intersection Curve first then select the plane.

To measure the thickness of a cross section of a part:

  1. With a part open, click Intersection Curve art\skt_icv.gif on the Sketch toolbar, or Tools, Sketch Tools, Intersection Curve.

    A 3D sketch opens (because you clicked art\skt_icv.gif before selecting a plane).

  2. Select the intersecting items:

  • Select a plane that intersects a face of the part.

  • Click the face of the part.

     

A sketched spline appears at the intersection of the plane and the top face.

art\ISECT-02_shg.gif

  1. Rotate the part, then click the opposite (inside) face of the part.

Another sketched spline appears on the inside face.

art\ISECT-03_shg.gif

You can also select the part in the FeatureManager design tree. A sketched spline appears on every face where the plane intersects.

  1. Click Tools, Measure and measure the distance between the two sketched splines.

 

art\ISECT-01_shg.gif



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