1. In a part or assembly document, click Design Table on the Tools toolbar, or click Insert, Design Table.

2. In the PropertyManager, under Source, select Auto-create.

3. Set the Edit Control settings and Options, as desired.

4. Click OK .

Depending on the settings you selected, a dialog box may appear that asks which dimensions or parameters you want to add.

An embedded worksheet appears in the window, and the SolidWorks toolbars are replaced with Excel toolbars.

Cell A1 identifies the worksheet as Design Table for: <model_name>.

5. Click anywhere outside of the worksheet (but in the graphics area) to close the design table.

1. In a part or assembly document, click Design Table on the Tools toolbar, or click Insert, Design Table.

2. In the PropertyManager, under Source, click Blank.

3. Set the Edit Control settings and Options, as desired.

4. Click OK .

Depending on the settings you selected, a dialog box may appear that asks which dimensions or parameters you want to add.

An embedded worksheet appears in the window, and the SolidWorks toolbars are replaced with Excel toolbars.

Cell A1 identifies the worksheet as Design Table for: <model_name>. Cell A3 contains the default name for the first new configuration, First Instance.

5. In row 2, type the parameters that you want to control. Leave cell A2 blank. Notice that cell B2 is active.

You can also enter parameters by double-clicking the feature or dimension in the graphics area or in the FeatureManager design tree. When you double-click a feature or dimension, its associated value appears in the Default row.

6. In column A (cells A3, A4, and so on), type the names of the configurations that you want to create. The names can include numerics, but must not include the forward slash (/) or at (@) characters.

You can change the configuration name in cell A3 (Default) if you want.

7. Type the parameter values in the worksheet cells.

8. When you finish adding information to the worksheet, click outside the table to close it.

   A message lists the configurations that were created.

9. Click OK.

   The design table is inserted in the model, and Design Table appears in the FeatureManager design tree.

1. In a part or assembly document, click Design Table on the Tools toolbar, or click Insert, Design Table.

   The Design Table PropertyManager appears.

2. Under Source:

3. • Click From file, then click Browse to locate the Excel file.

   • To link the design table to the model, select the Link to file check box. A linked design table reads all of its information from an external Excel file.

   NOTE: If you update a linked design table in Microsoft Excel, then open the SolidWorks model, you can choose to update either:

   • the model with the design table values

   - or -

   • the design table with the model values

   You can set the update options in Tools, Options, System Options, External References. Set Update out-of-date linked design tables to to Model , Excel file, or Prompt.

4. Set the Edit Control settings and Options, as desired.

5. Click OK .

   An embedded worksheet appears in the window, and the SolidWorks toolbars are replaced with Excel toolbars.

6. Click anywhere outside of the worksheet (but in the graphics area) to close the design table.